Unable to Make Rigid Groups

[Anonymous]

Internet please save me!

I have been trying for some time to get these parts to properly group together and have been having issues with it.

When I select a component and all its subcomponents and try to make a rigid group, it shows me dialog box that says "Rigid1 constrains selected components" or "RigidGroup2 constrains selected components" or something along those lines. Perhaps this is because I already made some constraints and this is complicating things?

Also, every once in a while I will get a message that says "Error during update" and I've been unable to fix that. I completely uninstalled and reinstalled the software.

I would like for this drawing to be divided into 6 different groups, with all bodies and components in group 1 moving together, and so forth.

Group A:
1_Uprights for Rovings + 1_LargeFibreFeed + 1_SmallFibreFeed + Pultrusions Equipment v14's bodies (I intended to make that into a component of its own but I messed up)
Joints: All rigid

Group B: 2_ResinBath
Joints: Revolute joint between the four "2_ResinBathSupports" and the main "2_ResinBath" component (the half-open box)

Group C: 3_FinalFibreFeed
Joints: All rigid

Group 😧 4_HeatedDie
Joints: All rigid

Group E: 5_HeatedDieBrackets
Joints: all rigid

Group F: 6_PullerAssembly + 7_Gears
Joints: Revolute or Cylindrical (I would like to properly align the gearshafts, but haven't done that yet as the file as it is is not very useful to me)

I have attached the .f3d file. Feel free to play around with it as much as you want.

Thanks in advance for the help!

Josh

Mid 2012 MacBook Air
OS X Yosemite Version 10.10.5
1.8 GHz Intel Core i5
8 GB 1600 MHz DDR3

Autodesk Fusion 360
2.0.2377
Active Plan: Student

[Beyondforce]

Hi @Anonymous,

First, you have to fix ALL the Yellow error! If you deleted bodies or components, which other bodies used them as reference, then you have a problem.

You NEVER delete a body or a component which has been used as a reference. Instead, you use the Remove command!

When you done fixing all the error and create components from all the bodies, then you can continue with the Rigid groups.

If you still have problems after doing the above, please let us know.

Cheers / Ben
---------------------------------------------------------------------------------------------------------------------------
Did you find this reply helpful ? If so please use the Accept as Solution or Kudos button below.

Check out my YouTube channel: Fusion 360: Newbies+

[ahreum.ryu · Accepted solution]

Hi @Anonymous, 

Welcome to the Fusion 360 community! 

First of all, I just focused on to divided 6 groups and when one sub ****'y move, all of them should follow the sub ****'y. (We normally use “move” function)

I’m sharing my working history please take a look at this.

For some reason, “1_uprightsForRovings subass’y” couldn’t move. I suspect that somewhere is related with other parts… it would take time to figure out. So I remove that part. And recreate.
I saw your working history, I think you worked as different part.

For example, when you create the bar, you create other space and then move to the right place. But I think you don’t need to do… just you create the body on the place you intended and you can select body or component

Also If you want to rotate your body in the 2_ResinBath. You should change from body to Component. Please take a look at this.

If i missed something, please let me know.

I think we need to understand some concepts to create 3D model

This article would help your understand

1. 5 Things You Should Know About Components and Bodies
2. Power of Top-Down Design with Fusion 360
3. Rigid group  

I'm attaching my file for reference. if you need more help, please let me know. I'll be glad to help you. 

Many thanks!

[TrippyLighting]

Fusion 360 R.U.L.E #1

When in doubt, before doing anything, create a component and make sure it's activated.
All objects created after activating the component such as sketches, bodies, construction geometry, joint origins, etc.  are created in that component.

This has several advantages:

1. On activation the timeline is filtered to show only those items in the timeline that pertain to that component. That will make the quickly growing timeline much easier to work with.
2. If a component is exported to the data panel with "save as" this will also export the complete parametric design history.
3. The joints in the "Assemble menu only work with components.
4. Drawings can only be created from components
5. Only components show on the BOM

When another component needs to be edited for example to add geometry, it should be activated before doing so.

Assemblies should not be structured like this:

—+— Assembly
    !—— Sketch
    !—— Body
    |—+—Component
         |— Sketch
         |— Body
    |—+—Component
         |— Sketch
         |— Body

But like this

:

—+— Assembly
    |—+—Component
         |— Sketch
         |— Body
    |—+—Component
         |— Sketch
         |— Body
    |—+—Component
         |— Sketch
         |— Body

[Anonymous]

Thank you so much for all of your help! This is my first project switching to any Autodesk projects, so it's been a sharp learning curve. Thank you for helping me get more comfortable with Fusion 360!