Convert Form into a Body and using edges and faces for press-pull and sweeps?

[joshalicea]

Hey folks! SO i have a situation thats driving me bonkers..
 
Ive created a Form, Sculpted it. then have attempted to convert it to Brep OR do a solid fill Something along the lines of the first few min of this video:
 
https://www.youtube.com/watch?v=VPpbaKqTS2c
 
he sculpts, patches and just does a solid fill and now he can extrude and do all these things...
 
I have tried doing a convert T-Spline to Brep  and including all edges, keeping symmetry....
 
Ive tried the Solid Fill method as shown on this video...
 
But in the end i get a BODY with selectable edges...but i cannot Use these edges for profile sweeps, i cannot actually get an extrude to work (just gives me an error) and when i click sweep none of the faces or edges can be selected for that operation...
 
ALSO i noticed i can make holes and edit that way, i can make a sketch in space and do a subtract and things like that.....but i need to add new geometry and have it joined and lined up with a profile that is a part of the form....OR do i have to project edges (i havent tried this yet to see if it works but typing is getting juices flowing) to a plane then create a sketch profile of that feature from my "CONVERTED" form and then extrude and work with that? 
 
Something seems broken with my order of operations...
 
Thanks folks! any help would be appreciated...
 
Public link is available here.. http://a360.co/2wCpsA2

[patrick.miller]

Here's what I understood you were looking for. I think it would also work in the model workspace but I went the scenic route to show using Patch as you described.

1. Create a Plane Along Path
2. Create a sketch on that plane.
3. Use Project > Include 3D Geometry and select your edges.
4. Switch to Patch.
5. Create a surface sweep using the projected profile and your path.
6. Create a Patch at the end of the sweep to close the body.
7. Stitch the Sweep and the Patch.
8. Create a Boundary Fill using the surface body and the solid body.
9. Turn off the visibility of the original solid and the construction surface.

Hope this helps. Let me know if you have questions with the process.

[patrick.miller]

Here's a quick Screencast (no audio) showing the steps.

[joshalicea]

So that leaves me with another set of questions.

Is the converted body i have in that link....the faces are not capable for Lofts, sweeps and extrudes? Why is this the case?

This solution WILL indeed Get me to where i think i need to be. i was just hoping it was going to be doable with the model and the faces i had.

That screen-cast is GOLD and i cant believe support like this exists like this! Im flabbergasted and elated all at once 

Thank you!

[patrick.miller · Accepted solution]

Faces must be exactly planar to use them in extrude, revolve, sweep, loft. You have to be very intentional to get planar faces out of the Sculpt workspace. This screencast shows one method to do that. 

1. Delete the faces so the body is open. We'll use Patch later to create a planar face.
2. Use Flatten to align the vertices of the body parallel to an origin plane.
3. Freeze those verts (you don't want them to move if you make changes to the sculpt body).
4. Go to Patch workspace and create a patch at the open end.
5. Stitch the surfaces into a solid body.
6. Sweep the face.

[joshalicea]

Incredible. I now know 3 new tools and a new workflow method thanks to you. Honestly this transition to Fusion has been one of the most enlightening experiences in my career thus far! I'm loving it and loving the strong community and support. The support and community really are what makes Fusion feel like family!!!

Thank you so much!!

(Sent from my mobile device)