Anuncios

The Autodesk Community Forums has a new look. Read more about what's changed on the Community Announcements board.

Anonymous
696 Vistas, 9 Respuestas

featurecam turn feeds mmpr

hi, when posting from featureturn to post processor the feeds are not transfering over when in mmpr. i get F0.  .if i run in mmpm and fixed spindle speed it is fine, if i alter the mmpr to a figure over 1.0 its fine so im assuming its not bringing the decimal places over (0.318) is default,i have checked in options ,decimal places and seems ok. ive tried it with all processors and materials. any ideas? 

Anonymous
en respuesta a: Anonymous

Hi @Anonymous,

 

I have tried with a face op. and all fine with me. can you share something?

 

Anonymous
en respuesta a: Anonymous
Anonymous
en respuesta a: Anonymous

% with mmpr enabled 
O0001 (~TOP PIN NEW 5-2-2018)
N1
(SW_PROFILE_35M_RH)
(ROUGH TURN TURN1)
G0 G21 G40 G80 G90 G95
G92 S3000
G96 S67 T0202 M3
X33.452 Z3.058 M8
G1 Z-77.731 F0.
X40.0
X40.898 Z-77.282
G0 Z3.058
G1 X26.904 F0.
Z-77.731
X33.452
X34.35 Z-77.282
G0 Z3.058
G1 X22.478 F0.
Z-52.442
G3 X26.773 Z-54.804 R16.987
X26.904 Z-55.0 R0.327
G1 X27.802 Z-54.551
G0 Z3.058
G1 X14.611 F0.
Z-49.761
G3 X22.478 Z-52.442 R16.987
G1 X23.376 Z-51.993
G0 Z3.058
G1 X12.254 F0.
Z-19.595
X12.844 Z-19.688
G3 X13.301 Z-19.991 R0.327
G1 X14.611 Z-44.991
G3 X14.611 Z-45.0 R0.327
G1 X15.509 Z-44.551
G0 Z3.058
G1 X11.759 F0.
Z0.318
X11.797 Z0.312
G3 X12.254 Z0. R0.327
G1 X13.152 Z0.449
G0 X31.984
Z-55.0
G1 X26.904 F0.
G3 X26.447 Z-55.312 R0.327
G1 X22.478 Z-55.938
Z-77.731
X26.904
X27.802 Z-77.282
G0 Z-55.938
G1 X22.478 F0.
Z-77.413
G3 X22.021 Z-77.725 R0.327
G1 X21.983 Z-77.731
X22.478
X23.376 Z-77.282
G0 X45.08

(FINISH TURN TURN1)
G92 S3000
G96 S91 M3
X45.08 Z2.597
X13.392
G1 X12.0 Z0. F0.
Z-19.688
X12.768 Z-19.809
G3 X13.047 Z-19.995 R0.2
G1 X14.357 Z-44.995
G3 X14.357 Z-45.0 R0.2
G1 Z-49.84
G3 X26.57 Z-54.88 R16.86
X26.65 Z-55.0 R0.2
X26.37 Z-55.191 R0.2
G1 X22.224 Z-55.844
Z-77.413
X26.099 Z-75.475
G0 X45.08
G0 G28 U0. W0. M9
T0200 M5
M30
%

 

 

% with mmpr unchecked and constant spindle speed
O0001 (~TOP PIN NEW 5-2-2018)
N1
(SW_PROFILE_35M_RH)
(ROUGH TURN TURN1)
G0 G21 G40 G80 G90 G94
G92 S960
G97 S960 T0202 M3
X33.452 Z3.058 M8
G1 Z-77.731 F366.
X40.0
X40.898 Z-77.282
G0 Z3.058
G1 X26.904 F366.
Z-77.731
X33.452
X34.35 Z-77.282
G0 Z3.058
G1 X22.478 F366.
Z-52.442
G3 X26.773 Z-54.804 R16.987
X26.904 Z-55.0 R0.327
G1 X27.802 Z-54.551
G0 Z3.058
G1 X14.611 F366.
Z-49.761
G3 X22.478 Z-52.442 R16.987
G1 X23.376 Z-51.993
G0 Z3.058
G1 X12.254 F366.
Z-19.595
X12.844 Z-19.688
G3 X13.301 Z-19.991 R0.327
G1 X14.611 Z-44.991
G3 X14.611 Z-45.0 R0.327
G1 X15.509 Z-44.551
G0 Z3.058
G1 X11.759 F366.
Z0.318
X11.797 Z0.312
G3 X12.254 Z0. R0.327
G1 X13.152 Z0.449
G0 X31.984
Z-55.0
G1 X26.904 F366.
G3 X26.447 Z-55.312 R0.327
G1 X22.478 Z-55.938
Z-77.731
X26.904
X27.802 Z-77.282
G0 Z-55.938
G1 X22.478 F366.
Z-77.413
G3 X22.021 Z-77.725 R0.327
G1 X21.983 Z-77.731
X22.478
X23.376 Z-77.282
G0 X45.08

(FINISH TURN TURN1)
G92 S3000
G96 S91 M3
X45.08 Z2.597
X13.392
G1 X12.0 Z0. F0.
Z-19.688
X12.768 Z-19.809
G3 G95 X13.047 Z-19.995 R0.2
G1 X14.357 Z-44.995
G3 X14.357 Z-45.0 R0.2
G1 Z-49.84
G3 X26.57 Z-54.88 R16.86
X26.65 Z-55.0 R0.2
X26.37 Z-55.191 R0.2
G1 X22.224 Z-55.844
Z-77.413
X26.099 Z-75.475
G0 X45.08
G0 G28 U0. W0. M9
T0200 M5
M30
%

Anonymous
en respuesta a: Anonymous

Hi @Anonymous

 

I can't see your video, you have private permission on.

 

abhishek.juvekar
en respuesta a: Anonymous

Hi @Anonymous,

 

Thanks for raising your query via Autodesk Forum.

 

Can you please refer the image below and check the factors set in your post-processor?  Inch Format / Metric Format — These boxes specify the number of digits to be displayed in imperial and metric formats. 

Also keep  Decimal Point checked which is just below the factors, to include a decimal point in values. For example, when Decimal point is selected, 100 is output as 100.0.

 

 

factor.png

 

Hope this helps. If my post answers your question, please click on 'Accept as solution' button.

 

Thank You.

 

 



Abhishek
Anonymous
en respuesta a: abhishek.juvekar

GREAT THANKS,  it was one of the metric format boxes not set to 4.3  on word page 1 .i have a friend with a similar set up and copied his .how do i modify the processor to include m41 or m40 for gear selection at the start of the programme as in what text would i write in the format,programme start as below

<IF>[eq(<FM-NAME>,<PROG-NAME>)]<THEN>[:<PROG-NAME>="0001"]<ENDIF>
%<EOB>
O<PROG-NAME> ([UPPERCASE(<FM-NAME>)] <DATE>)<EOB>
N[<SEQ>:n_num=1]<EOB>
([UPPERCASE(<TOOL-NAME>)])<EOB>
(<OP-PASS> <OP-TYPE> <SEGM-ID>)<EOB>
<MOTION> <UNITS> G40 G80 G90 <F-UNITS><EOB>
G92 S<SP-MAX><EOB>
<IF><CSS-ON><THEN>
G96 S<CSS-SPEED>
<ENDIF>
<IFNOT><CSS-ON><THEN>
G97 S<SPEED>
<ENDIF>
<BOL> T<TOOL><OFFSET#> <SPINDLE><EOB>
X<X-COORD> Z<Z-COORD> <COOLANT><EOB>

 

thanks for your help ,neil  

Anonymous
en respuesta a: abhishek.juvekar

HI,thanks for the help, do you know what i need to write in the xbuild post processor start option to give the lathe its M40 M41 M42 transmission gear options  thanks neil

abhishek.juvekar
en respuesta a: Anonymous

Hello @Anonymous,

 

I am not a post-processor expert but refer the image below:

 

E8193674.PNG

AND add <SP-RANGE> in POST

This hook the values M41 AND M42 depending on speed selected in FeatureCAM.

 

Hope this helps.

 

Thank You.



Abhishek
Anonymous
en respuesta a: Anonymous

thanks, worked a treat,