topic Re: Ilogic: open assembly from part in Inventor Programming Forum

Ilogic: open assembly from part

Anonymous — Tue, 26 May 2020 08:09:47 GMT

I am trying to open an assembly from a part, and then use the filename from that part and save the assembly with the same filename.

Is that possible? and can I get the drawing file for that assembly also?

Re: Ilogic: open assembly from part

chandra.shekar.g — Wed, 27 May 2020 11:10:57 GMT

@Anonymous,

It always the case that parts can be opened from assembly and not visa versa. Unless the parts are added into assembly, part can not linked to assembly.

Similarly, a part or assembly can be opened from linked drawing.

Thanks and regards,

Re: Ilogic: open assembly from part

marcin_otręba — Wed, 27 May 2020 11:20:06 GMT

you can do it if on save of assembly tyou will write custom iproperty in each occurrance reference document like parent_ass in which you will store assembly.fullfilename. Then you can read this iproperty and open it from part.

But in thiis scenario part cant be used in more than in 1 assembly.

Re: Ilogic: open assembly from part

marcin_otręba — Wed, 27 May 2020 12:49:41 GMT

sorry i just read your post again,

do you want to create assembly wchich will be na,med as part with that part in it ?

Re: Ilogic: open assembly from part

Anonymous — Wed, 27 May 2020 13:03:47 GMT

Yes exactly and use the title from the part on the assembly

Re: Ilogic: open assembly from part

marcin_otręba — Thu, 28 May 2020 05:56:16 GMT

hi,

try

Dim name As String = ThisDoc.Document.FullFileName
Dim title As String = ThisDoc.Document.PropertySets(1).Item("title").Value
Dim ass As AssemblyDocument = ThisApplication.Documents.Add(DocumentTypeEnum.kAssemblyDocumentObject, , True)
ass.PropertySets(1).Item("title").Value = title
 Dim oTG As TransientGeometry
   oTG = ThisApplication.TransientGeometry
Dim oMatrix As Matrix
oMatrix = oTG.CreateMatrix
oMatrix.SetTranslation(oTG.CreateVector(0, 0, 0)) 
ass.ComponentDefinition.Occurrences.Add(name,oMatrix)
ass.SaveAs(Replace(name, ".ipt", ".iam"), False)

Re: Ilogic: open assembly from part

Anonymous — Thu, 28 May 2020 07:20:33 GMT

That is exactly what I needed, thank you very much.

If I need to run an external rule on that assembly, how do I do that?

Re: Ilogic: open assembly from part

marcin_otręba — Thu, 28 May 2020 07:49:35 GMT

Ilogic external configuration:

https://autodeskmfg.typepad.com/blog/2012/01/working-with-external-ilogic-rules.html

https://adndevblog.typepad.com/manufacturing/2015/01/add-external-ilogic-rule-to-event-trigger.html

i have polish version of inventor so i will not be able to post print screens to you because you will not understand 🙂

then change rule to this (it checks document sub type):

If ThisApplication.ActiveDocument.subtype<>"{BBF9FDF1-52DC-11D0-8C04-0800090BE8EC}" And ThisApplication.ActiveDocument.subtype<>"{E60F81E1-49B3-11D0-93C3-7E0706000000}" Then
Dim name As String = ThisDoc.Document.FullFileName
Dim title As String = ThisDoc.Document.PropertySets(1).Item("title").Value
Dim ass As AssemblyDocument = ThisApplication.Documents.Add(DocumentTypeEnum.kAssemblyDocumentObject, , True)
ass.PropertySets(1).Item("title").Value = title
 Dim oTG As TransientGeometry
   oTG = ThisApplication.TransientGeometry
Dim oMatrix As Matrix
oMatrix = oTG.CreateMatrix
oMatrix.SetTranslation(oTG.CreateVector(0, 0, 0)) 
ass.ComponentDefinition.Occurrences.Add(name,oMatrix)
ass.SaveAs(Replace(name, ".ipt", ".iam"), False)
End If

Re: Ilogic: open assembly from part

Anonymous — Thu, 28 May 2020 08:17:57 GMT

Maybe I was unclear.

I would like to do something like this:

Dim name As String = ThisDoc.Document.FullFileName
Dim title As String = ThisDoc.Document.PropertySets(1).Item("title").Value
Dim ass As AssemblyDocument = ThisApplication.Documents.Add(DocumentTypeEnum.kAssemblyDocumentObject, , True)
ass.PropertySets(1).Item("title").Value = title
 Dim oTG As TransientGeometry
   oTG = ThisApplication.TransientGeometry
Dim oMatrix As Matrix
oMatrix = oTG.CreateMatrix
oMatrix.SetTranslation(oTG.CreateVector(0, 0, 0)) 
ass.ComponentDefinition.Occurrences.Add(name,oMatrix)
iLogicVB.RunExternalRule("Configure") ' This rule should run on the assembly
ass.SaveAs(Replace(name, ".ipt", ".iam"), False)

Re: Ilogic: open assembly from part

marcin_otręba — Thu, 28 May 2020 08:19:31 GMT

https://forums.autodesk.com/t5/inventor-customization/run-ilogic-rule-from-another-rule/td-p/6994012

Re: Ilogic: open assembly from part

Anonymous — Thu, 28 May 2020 08:29:33 GMT

I solved it this way:

assembly = ThisApplication.ActiveDocument
auto = iLogicVb.Automation
auto.RunRule(assembly,"Configure")

Thank you for your help