iLogic coding help.

andrew_wade1 — Tue, 22 Oct 2024 15:15:59 GMT

I am looking to write a iLogic code to turn off visibility of planes, sketches, datums, points... To help clean up both part and assembly files. At the same time at the end bring the part or assembly back to home and fit. I have started with basic vb code and kind of got it to work with the parts but not the assembly. Thank you.

Re: iLogic coding help.

patrick.schlambHPACQ — Tue, 22 Oct 2024 17:28:43 GMT

Here is a very basic set of code to turn off the object visibility and set the view to home. There are a lot of options within the object visibility that you can dig deeper into. This acts the same as just turning off the object visibility in the View tab of the ribbon.

Sub Main()
	Dim doc As AssemblyDocument = ThisDoc.Document
	Dim objVis As ObjectVisibility = doc.ObjectVisibility
	
	objVis.AllWorkFeatures = False
	
	ThisApplication.CommandManager.ControlDefinitions.Item("AppViewCubeHomeCmd").Execute
    ThisApplication.ActiveView.Fit
	
End Sub 'Main

Re: iLogic coding help.

WCrihfield — Tue, 22 Oct 2024 18:16:01 GMT

Hi @andrew_wade1. This task has been a relatively popular one on this forum over the years, so if you used the search functionality of this forum, you will likely see lots of other conversations about it, and lots of other example codes you could try out. Many of them only turn off work features, such as WorkPoints, WorkAxes, and WorkPlanes, but some also work with other types of things. Below is an example iLogic rule you can try out for a task like that.

However, this can be a relatively complex task, with lots of different aspects and details involved, each of which may cause this task to not work exactly as planned. Visibility settings are saved within the DesignViewRepresentations that are within the RepresentationsManager of the ComponentDefinition, within each document. Then, every individual assembly component occurrence can each have their DVR (DesignViewRepresentation) set differently, which potentially means different appearances or visibility settings. If you are not using all the DVR settings along the way in each document and in each occurrence, then this may not work properly for you.

Sub Main Dim oDoc As Inventor.Document = ThisDoc.Document Dim oTrans As Inventor.Transaction oTrans = ThisApplication.TransactionManager.StartTransaction(oDoc, "Set Visibility - iLogic") SetVisibility(oDoc, False) Dim oRefDocs As DocumentsEnumerator = oDoc.AllReferencedDocuments For Each oRefDoc As Inventor.Document In oRefDocs SetVisibility(oRefDoc, False) Next oRefDoc oDoc.Update2(True)'do not use 'If oDoc.RequiresUpdate', it will be False oTrans.End 'If oDoc.Dirty Then oDoc.Save2(True) End Sub Sub SetVisibility(oDoc As Document, bVisible As Boolean) If oDoc Is Nothing OrElse oDoc.IsModifiable = False Then Return If (Not TypeOf oDoc Is AssemblyDocument) AndAlso (Not TypeOf oDoc Is PartDocument) Then Return Dim oCD As ComponentDefinition = oDoc.ComponentDefinition For Each oWA As WorkAxis In oCD.WorkAxes If oWA.Visible <> bVisible Then oWA.Visible = bVisible Next For Each oWP As WorkPlane In oCD.WorkPlanes If oWP.Visible <> bVisible Then oWP.Visible = bVisible Next For Each oWPt As WorkPoint In oCD.WorkPoints If oWPt.Visible <> bVisible Then oWPt.Visible = bVisible Next Try 'assemblies do not have these, only parts For Each oWS As WorkSurface In oCD.WorkSurfaces If oWS.Visible <> bVisible Then oWS.Visible = bVisible Next Catch : End Try For Each oSketch As PlanarSketch In oCD.Sketches If oSketch.Visible <> bVisible Then oSketch.Visible = bVisible Next Try 'assemblies do not have these, only parts For Each o3DSketch As Sketch3D In oCD.Sketches3D If o3DSketch.Visible <> bVisible Then o3DSketch.Visible = bVisible Next Catch : End Try For Each oMA As ModelAnnotation In oCD.ModelAnnotations If oMA.Visible <> bVisible Then oMA.Visible = bVisible Next 'oDoc.Update2(True) End Sub

If this solved your problem, or answered your question, please click ACCEPT SOLUTION .
Or, if this helped you, please click (LIKE or KUDOS) 👍.

topic Re: iLogic coding help. in Inventor Programming Forum

iLogic coding help.

Re: iLogic coding help.

Re: iLogic coding help.