topic Re: Honeycomb pattern with rectangular pattern makes Fusion 360 unresponsive. in Fusion Support Forum

Honeycomb pattern with rectangular pattern makes Fusion 360 unresponsive.

Anonymous — Sun, 29 Mar 2020 14:31:16 GMT

I am getting rather frustrated creating a simple honeycomb pattern. The pattern was created as a sketch using rectangular pattern which seems to be a performance killer.

I also tried this out with rectangular pattern outside sketch mode with feature but it equally slows down Fusion and I am unable to use partial pattern on the edges + suppression cannot be edited.

Is there a better way?

Re: Honeycomb pattern with rectangular pattern makes Fusion 360 unresponsive.

g-andresen — Sun, 29 Mar 2020 15:34:37 GMT

Hi,

Note:

1. Patterns should never be created in Sketch mode, except for those that have few elements.

2. in your case create 2 polygons > extrude/cut them > create pattern (feature or faces) > option: indentical or optimize.

Furthermore, it should be considered not to use the polyons but the separating bars.
A structure of this type is then placed over the cutout and joined to the remaining body.

it´s only german language, sorry

günther

Re: Honeycomb pattern with rectangular pattern makes Fusion 360 unresponsive.

MoshiurRashid — Sun, 29 Mar 2020 15:31:54 GMT

Thanks for posting. As I can see, if you want to keep the design history, there is no other way than just reduce graphics performance by following this link .

If you don't want the design history let me know.

Re: Honeycomb pattern with rectangular pattern makes Fusion 360 unresponsive.

TheCADWhisperer — Sun, 29 Mar 2020 18:44:38 GMT

@Anonymous

It is usually better to Pattern Features rather than Sketch elements.

(See Attached)

Re: Honeycomb pattern with rectangular pattern makes Fusion 360 unresponsive.

g-andresen — Mon, 30 Mar 2020 08:54:22 GMT

Hi,

in addition to my contribution #2

Furthermore, it should be considered not to use the polyons but the separating bars.
A structure of this type is then placed over the cutout and joined to the remaining body.

I extruded the profile in surface environment and thickened symmetrically. This gives me more variation options. The individual elements of the pattern were combined and then, after they were inserted into the cutout, blended with its outline. The element can then be saved separately and used in other designs with modification if necessary.

In the attached file I used the pattern type "Faces" because I had the best experience with it (speed).

But also try "Features" and the compute options "Identical" and "Optimized".

günther

Screencast