topic Re: Sweep using horizontal and vertical paths in Fusion Design, Validate & Document Forum

Sweep using horizontal and vertical paths

GrayWolfRedRocks — Thu, 25 May 2023 01:37:59 GMT

How do I perform a sweep using two paths and a profile? The profile is the shape I want extruded along the path. The paths represent the horizontal (XY plane) and vertical (XZ plane) movement of the profile. I can make a profile extrude along a single path that represents the vertical movement but now I want to add a second path to make the profile move horizontally. How can I do this in Fusion?

update: I've been trying the sweep command. I don't want the second path to stretch or otherwise change the shape of the profile. I only want the path to move the profile.

Betreff: Sweep using horizontal and vertical paths

g-andresen — Wed, 24 May 2023 08:41:25 GMT

Hi,

Please share the file.

File > export > save as f3d on local drive > attach it to the post.

günther

Re: Sweep using horizontal and vertical paths

GrayWolfRedRocks — Thu, 25 May 2023 01:38:47 GMT

File added to the original post. Thanks!

Re: Sweep using horizontal and vertical paths

jeff_strater — Thu, 25 May 2023 02:58:01 GMT

Is this what you are after?

The key here is the Project->Intersection Curve command in sketch. This creates a 3D curve from the intersection of 2 2D curves.

The next problem is that the profile is not on that path. So, I used Plane Along Path and Copy/Paste to put the profile on the end of the path, then it works. Model is attached. I'll record a video next

Re: Sweep using horizontal and vertical paths

jeff_strater — Thu, 25 May 2023 03:03:56 GMT

video. Note that I was not all that careful at pasting the sketch. It would have been better to move the sketch precisely to the origin using point-to-point Move in sketch mode.

(view in My Videos)

Re: Sweep using horizontal and vertical paths

GrayWolfRedRocks — Thu, 01 Jun 2023 01:20:58 GMT

Thanks, Jeff. That's what I was looking to do. I'll watch your video and play around with the paths to develop my workflow.

I noticed the profile is rotated. Is there a way to control the rotation? I'd like to prevent any rotation and keep the profile oriented as drawn.

Thanks!

Scott

Re: Sweep using horizontal and vertical paths

jeff_strater — Thu, 01 Jun 2023 03:16:34 GMT

"I noticed the profile is rotated. Is there a way to control the rotation?"

Are you talking about the initial orientation of the profile, or twist along the sweep? The way to control the initial orientation is by placing it on the plane at the end of the path in the orientation you want, instead of on one of the input curves to the intersected path. If you are talking about twist along the sweep, using a Sweep with Path and Guide Surface is the best way to control that. Create or select a plane that matches the side you want to keep flat, and choose that as the guide surface.