topic Re: Flat pattern into existing drawings in Fusion Design, Validate & Document Forum

Flat pattern into existing drawings

lesterN4P2J — Sun, 17 Nov 2019 15:53:28 GMT

Is it possible to insert a flat pattern into an existing drawing as opposed to creating drawing of flat pattern first?

Re: Flat pattern into existing drawings

TheCADWhisperer — Sun, 17 Nov 2019 16:13:44 GMT

Can you Attach example here.

I see so many people get confused about model/drawing.

Re: Flat pattern into existing drawings

lesterN4P2J — Sun, 17 Nov 2019 16:32:46 GMT

Hi

If I set up a drawing of a sheetmetal part and start with the flat pattern I can then add the part in different folded angles but if I start with the modelled part, I can’t then import the flat pattern. It doesn’t give me the option?

Re: Flat pattern into existing drawings

lesterN4P2J — Sun, 17 Nov 2019 16:33:53 GMT

If I set up a drawing of a sheetmetal part and start with the flat pattern I can then add the part in different folded angles but if I start with the modelled part, I can’t then import the flat pattern. It doesn’t give me the option?

Re: Flat pattern into existing drawings

TheCADWhisperer — Sun, 17 Nov 2019 17:50:45 GMT

What you have written does not make sense to me.

Please File>Export and then Attach *.f3d file(s) that illustrate the behavior.

OK, I have read your problem description again. Please include screenshots as well Fusion 360 file(s).

Re: Flat pattern into existing drawings

carl.j.barker — Sun, 17 Nov 2019 20:22:49 GMT

There are 2 similar ways to do this.

Method 1.

First make sure you are in the design workspace then activate the flat pattern you need in the drawing. Now use the workspace drop down to select Drawing -> from design. This will open up a dialog with the top section grayed out (more on this in method 2). You now need to use the destination drop down to select the drawing you want the pattern on, This will be 'UNTITLED' if you have not saved the drawing yet, after setting that a new drop down appears with which you need to set the sheet (if you have not named them yet then it will show sheet 1, sheet 2 etc.). Now press OK and fusion will change to your drawing and the flat pattern will be on you cursor ready to drop where you want.

Method 2.

This way does not require you to activate the flat pattern. Back again in the design workspace use the workspace dropdown to select drawing -> from design, when the dialog pops up uncheck full assembly then click the component you want the flat from, this will give you a new drop down to select from folded or flat (this was the grayed out bit from method 1), pick flat. the rest is the same as method 1 (set destination).

Hopefully this is what you wanted.

Re: Flat pattern into existing drawings

Anonymous — Mon, 18 Nov 2019 10:35:39 GMT

Thanks for the tip!

Re: Flat pattern into existing drawings

lesterN4P2J — Mon, 18 Nov 2019 14:39:04 GMT

Excellent!!!

Worked a treat. I couldn't work out how to do this and I was always needing to do Flat pattern first.

Many thanks Carl

Re: Flat pattern into existing drawings

tsheaAVV3P — Tue, 10 Dec 2024 15:33:00 GMT

This does not seem to work if the sheet metal component has been inserted into the assembly as a link. Edit it place does not allow to flatten, and when opened in original drawing does not list the other drawing as an option.

Re: Flat pattern into existing drawings

carl.j.barker — Tue, 10 Dec 2024 20:18:25 GMT

In this case use the create drawing dialog to get to the flat pattern. As long as the linked component has a flat pattern when initially saved it will be available.

This dialog has changed with the visible option since this guide was written.

Re: Flat pattern into existing drawings

JD_AGPL — Mon, 10 Feb 2025 21:54:43 GMT

Great.. Thanks !