topic Re: Complex Angle Faces: How to dimension in drawing? in Fusion Design, Validate & Document Forum

Complex Angle Faces: How to dimension in drawing?

tonySWCR2 — Thu, 03 Sep 2020 17:50:02 GMT

Hello All,

Attached is a simple sheet metal part that has non-perpendicular bends. This causes the face to be angled in all three main planes. In the example there are 2 holes on this face. How do I dimension them in a F360 drawing? I know how I would do it in other packages but Im lacking tools in F360. Can it be done?

Lets ignore that its sheet metal and you could flat pattern it, imagine its a solid part so making a flat component view isn't an option.

Cheers,

Tony

Re: Complex Angle Faces: How to dimension in drawing?

jhackney1972 — Thu, 03 Sep 2020 20:39:57 GMT

It starts with a Named View in the model and then you create a modified Section View in the drawing. I created a blog article and video on this process which you can view here. I am sharing the drawing as a public link. I have never done this before so I do not know how it will work. You may have to use direct dimensioning instead of the dynamic dimensions for example I used the Diameter dimension command on the hole diameter instead of the dynamic dimension tool. You will not get automated centerlines to work either, you could sketch they yourself.

Edit: Look down further is forum question for a point that @laughingcreek made about how I went a little too far with my methods. I got so involved thinking this was a great opportunity to show my method of Auxiliary Views I lost sight of the simple method of doing this. Sorry, I hope you will take a look at my Blog article anyway.

Re: Complex Angle Faces: How to dimension in drawing?

laughingcreek — Thu, 03 Sep 2020 20:25:19 GMT

@jhackney1972 -why the section view? if you "look at" that face and name a view in the model, using that in the drawing produces a view that you can use center marks on, and avoids having to create a section view.

Re: Complex Angle Faces: How to dimension in drawing?

jhackney1972 — Thu, 03 Sep 2020 20:33:44 GMT

Good Point! I got so wrapped up in the fact that this was an example of the method I used in my blog article on Auxiliary Views I guess I missed the obvious. I can't see the forest for the trees! I will edit my post, thanks.

Re: Complex Angle Faces: How to dimension in drawing?

tonySWCR2 — Thu, 03 Sep 2020 20:51:40 GMT

~deleted~

Re: Complex Angle Faces: How to dimension in drawing?

tonySWCR2 — Thu, 03 Sep 2020 20:38:24 GMT

I had kind of half muddled my way to the point of using section views as aux views but its so hard to get them to line up. Found a video you made on youtube which helped, using the green boxes and dragging across the dotted line to keep the view parallel. Where I was going wrong (by which I mean, where fusion fails me) was trying to use the smart dim tool, I just tried with the linear dimension tool and it works! Unfortunately, still no centre marks.

Cheers for you help.

Re: Complex Angle Faces: How to dimension in drawing?

jhackney1972 — Thu, 03 Sep 2020 20:44:06 GMT

As @laughingcreek pointed out, using a Named View takes care of everything, including the Center Marks.

Re: Complex Angle Faces: How to dimension in drawing?

chrisplyler — Thu, 03 Sep 2020 20:47:52 GMT

Unless there is some reason that this isn't acceptable...I would just dimension them on the Flat Pattern view.

Re: Complex Angle Faces: How to dimension in drawing?

tonySWCR2 — Thu, 03 Sep 2020 20:50:48 GMT

So it does.

My real life problem has the face obscured by another feature in the component so I had to use your method, therefor loosing the CM's.

Re: Complex Angle Faces: How to dimension in drawing?

tonySWCR2 — Thu, 03 Sep 2020 20:52:44 GMT

@chrisplyler there is always one

"Lets ignore that its sheet metal and you could flat pattern it, imagine its a solid part so making a flat component view isn't an option. "

Re: Complex Angle Faces: How to dimension in drawing?

laughingcreek — Thu, 03 Sep 2020 21:06:38 GMT

@tonySWCR2 wrote:

...My real life problem has the face obscured by another feature in the component so I had to use your method, therefor loosing the CM's.

if you start looking straight on b/c you used a named view, the cross-section is much easier to draw. you can have your obscured view and also have your center marks-

Re: Complex Angle Faces: How to dimension in drawing?

chrisplyler — Fri, 04 Sep 2020 12:37:10 GMT

@tonySWCR2 wrote:
@chrisplyler there is always one

Sometimes I am the one. It happens.