topic API: change Parameter and save in current folder in Fusion API and Scripts Forum

API: change Parameter and save in current folder

maik_staudt — Fri, 05 Mar 2021 08:03:36 GMT

Hi,

I want to write a function that changes a parameter and then saves the document to the current folder (not locally, but in the cloud) (or the folder where the "template-part" is located. The filename should be something like "projectname_" + the parameter. E.g. "projectname_350".

The code I have written is here:

#Author- #Description- import adsk.core, adsk.fusion, adsk.cam, traceback, time def run(context): ui = None try: app = adsk.core.Application.get() ui = app.userInterface design = app.activeProduct parameters = design.allParameters def param_and_save(abstand): abstand_param = parameters.itemByName('Achsabstand') abstand_param.expression = str(abstand) adsk.doEvents() time.sleep(2) app.activeDocument.saveAs('test', '', '', '') # <- how can I save it ? abstand = [50, 640, 736, 298] for x in abstand: param_and_save(x) except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))

Changing the parameters works perfectly. But how can I save every document separately in the current project-folder ?

The line "app.activeDocument.saveAs('test', '', '', '')" doesnt work.

It seems that the function needs a name and a Project-folder and two other parameters ? How is this it done right ?

And another rather general question: Where can I find the definition of all the functions availibe ? For example in the Object Model-PDF-file I cant find the saveAs-funktion ?

And would it also be possible to just Copy a component inside a document with different name and different parameter "Achsabstand" ? (copy component and paste new) ? How would that be done ?

Thanks 😊

Re: API: change Parameter and save in current folder

kandennti — Fri, 05 Mar 2021 14:16:40 GMT

Hi @maik_staudt .

For now, let's talk about saveAs.

https://help.autodesk.com/view/fusion360/ENU/?guid=GUID-7b292219-62fa-4a01-b522-2a1a297edb28
Fusion360's data panel can be saved under the same name, but I think it is better to use a different name to avoid confusion.

The dataFolder needs to be passed a DataFolder object.

https://help.autodesk.com/view/fusion360/ENU/?guid=GUID-a0938aea-0657-4784-9cfc-f5757627ae99

In this sample, we will save the four documents in the same folder as the active document when we run the split.
Be sure to execute it with the document saved once.

import adsk.core, adsk.fusion, adsk.cam, traceback, time def run(context): ui = None try: app = adsk.core.Application.get() ui = app.userInterface design = app.activeProduct parameters = design.allParameters def param_and_save( abstand :int, folder :adsk.core.DataFolder, fileHeader :str): abstand_param = parameters.itemByName('Achsabstand') abstand_param.expression = str(abstand) # adsk.doEvents() # time.sleep(2) # saveAs # https://help.autodesk.com/view/fusion360/ENU/?guid=GUID-7b292219-62fa-4a01-b522-2a1a297edb28 app.activeDocument.saveAs(f'{fileHeader}_{abstand}', folder, '', '') # get DataFolder # https://help.autodesk.com/view/fusion360/ENU/?guid=GUID-a0938aea-0657-4784-9cfc-f5757627ae99 folder :adsk.core.DataFolder = app.activeDocument.dataFile.parentFolder fileHeader = app.activeDocument.name abstand = [50, 640, 736, 298] for x in abstand: param_and_save(x, folder, fileHeader) app.activeViewport.refresh() ui.messageBox('Done') except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))

Betreff: API: change Parameter and save in current folder

maik_staudt — Sun, 11 Apr 2021 06:08:09 GMT

Thanks a lot, Kandennti,

The script works perfectly.

Is there also a way to copy the component inside the main-assembly with different parameter ?

Thanks,

Maik 🙂

Betreff: API: change Parameter and save in current folder

kandennti — Tue, 13 Apr 2021 09:18:30 GMT

@maik_staudt .

I interpreted it to mean something like this.

There were variations in the execution time.
This video is the one that was processed in a fairly short time.

# Fusion360API Python script import adsk.core, adsk.fusion, adsk.cam, traceback, time def run(context): ui = None try: app = adsk.core.Application.get() ui = app.userInterface design = app.activeProduct parameters = design.allParameters start = time.time() def param_and_save( abstand :int, folder :adsk.core.DataFolder, fileHeader :str) -> str: abstand_param = parameters.itemByName('Achsabstand') abstand_param.expression = str(abstand) docName = f'{fileHeader}_{abstand}' # saveAs # https://help.autodesk.com/view/fusion360/ENU/?guid=GUID-7b292219-62fa-4a01-b522-2a1a297edb28 app.activeDocument.saveAs(docName, folder, '', '') return docName def waitFinishedSaving( doc :adsk.core.Document): try: id = doc.dataFile.id except: id = '' while True: adsk.doEvents() try: doc.dataFile if id != doc.dataFile.id: break except: time.sleep(0.1) def getDataFileFromDataPanel( docNames :list, folder) -> list: wait = 3.0 while True: try: folder.dataFiles.asArray() break except: time.sleep(wait) adsk.doEvents() names = [] while True: for name in docNames: if not name in names: time.sleep(wait) break else: app.executeTextCommand('DataPanel.reload') names = [f.name for f in folder.dataFiles.asArray()] adsk.doEvents() continue break dataFiles = folder.dataFiles.asArray() files = [] for name in docNames: for df in dataFiles: if name == df.name: files.append(df) break else: continue return files # get DataFolder # https://help.autodesk.com/view/fusion360/ENU/?guid=GUID-a0938aea-0657-4784-9cfc-f5757627ae99 folder :adsk.core.DataFolder = app.activeDocument.dataFile.parentFolder fileHeader = app.activeDocument.name # update parameter & saveas abstand = [50, 640, 736, 298] docNames = [] viewport = app.activeViewport for x in abstand: docNames.append(param_and_save(x, folder, fileHeader)) viewport.refresh() viewport.fit() # get datafile dataFileList = getDataFileFromDataPanel(docNames, folder) # clese activeDocument app.activeDocument.close(False) # create assy doc assyDoc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType) assyDoc.saveAs(f'{fileHeader}_Assy', folder, '', '') waitFinishedSaving(assyDoc) assyOccs = assyDoc.design.rootComponent.occurrences # insert Doc matZero = adsk.core.Matrix3D.create() for dataFile in dataFileList: assyOccs.addByInsert(dataFile, matZero, True) adsk.doEvents() viewport.refresh() viewport.fit() ui.messageBox(f'Done\n{time.time() - start}s') except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))

Betreff: API: change Parameter and save in current folder

espablo — Sun, 21 Jan 2024 22:28:57 GMT

I tried to run this script and I must admit that it stopped working. The effect of its operation is the same as what I described in my post and the saveaAS() method does not work properly.
Link to my post:
https://forums.autodesk.com/t5/fusion-360-api-and-scripts/saveas-multiple-documents/td-p/12467126