topic Re: Previous working API Python script now fails at Project Body Projection Link in Fusion API and Scripts Forum

Previous working API Python script now fails at Project Body Projection Link

info83PHN — Tue, 13 Sep 2022 14:33:38 GMT

I have a python API script I wrote about a year ago ( around 3 or 4 Fusion updates ago ).

It was working perfectly at the time.

Now it fails when I try and Project existing Bodies to a new Sketch.

It appears that the script is executing the Project Body with the 'Projection Link' turned OFF.

If I create the Body Projections manually with 'Projection Link' turned ON, then the result is exactly as I need it to be.

Is it possible to set the 'Projection Link' to ON within a Script ?

# create a sketch for the border shape # create sketch on the 'TextPlane' plane uTextPlane = rootComp.constructionPlanes.itemByName('TextPlane') sketches = rootComp.sketches sketch = sketches.add(uTextPlane) sketch.name = 'Border' projectedSketchEntities = [] for body in inputColl: projectedEntities = sketch.project(body) projectedSketchEntities.extend([e for e in projectedEntities])

Re: Previous working API Python script now fails at Project Body Projection Link

kandennti — Wed, 14 Sep 2022 01:38:58 GMT

Hi @info83PHN .

I tried it and saw that the link was indeed broken. I think it is probably a bug.

The screen moves, but I made a sample using text commands as an alternative.

# Fusion360API Python script import traceback import adsk.fusion import adsk.core def run(context): ui = adsk.core.UserInterface.cast(None) try: app: adsk.core.Application = adsk.core.Application.get() ui = app.userInterface des: adsk.fusion.Design = app.activeProduct rootComp: adsk.fusion.Component = des.rootComponent uTextPlane = rootComp.constructionPlanes.itemByName('TextPlane') sketches = rootComp.sketches sketch = sketches.add(uTextPlane) sketch.name = 'Border' projectedEntities = projectBodies(sketch, rootComp.bRepBodies) except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc())) def projectBodies( skt: adsk.fusion.Sketch, bodies: list) -> list: tokens = [c.entityToken for c in skt.sketchCurves] tokens.extend([p.entityToken for p in skt.sketchPoints]) app: adsk.core.Application = adsk.core.Application.get() sels: adsk.core.Selections = app.userInterface.activeSelections sels.clear() sels.add(skt) app.executeTextCommand(u'Commands.Start SketchActivate') sels.clear() app.executeTextCommand(u'Commands.Start ProjectNewCmd') app.executeTextCommand(u'Commands.SetString infoFilterType {}'.format('infoFilterTypeBodies')) [sels.add(body) for body in bodies] app.executeTextCommand(u'NuCommands.CommitCmd') app.executeTextCommand(u'Commands.Start SketchStop') projectedEntities = [c for c in skt.sketchCurves if not c.entityToken in tokens] projectedEntities.extend([p for p in skt.sketchPoints if not p.entityToken in tokens]) return projectedEntities

Re: Previous working API Python script now fails at Project Body Projection Link

BrianEkins — Wed, 14 Sep 2022 08:37:27 GMT

I can reproduce this and confirm it is a bug. Hopefully, it can be fixed soon.

Re: Previous working API Python script now fails at Project Body Projection Link

info83PHN — Wed, 14 Sep 2022 09:38:31 GMT

Many Thanks
Do we need to report this bug somewhere to get it corrected ?
I am wasting hours with having to manually do the projections manually

Re: Previous working API Python script now fails at Project Body Projection Link

BrianEkins — Wed, 14 Sep 2022 18:49:46 GMT

Autodesk is aware of the problem, thanks to you reporting it, and are looking into it.

Re: Previous working API Python script now fails at Project Body Projection Link

BrianEkins — Fri, 23 Sep 2022 15:55:17 GMT

It looks like this has been fixed in the latest update.