<?xml version="1.0" encoding="UTF-8"?>
<rss xmlns:content="http://purl.org/rss/1.0/modules/content/" xmlns:dc="http://purl.org/dc/elements/1.1/" xmlns:rdf="http://www.w3.org/1999/02/22-rdf-syntax-ns#" xmlns:taxo="http://purl.org/rss/1.0/modules/taxonomy/" version="2.0">
  <channel>
    <title>topic Doosan Mill/Turn Y axis milling issues in Fusion Manufacture</title>
    <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11006644#M119125</link>
    <description>&lt;P&gt;Hi, would like to mill a part&amp;nbsp; similar to the attached part using&amp;nbsp; Y axis rather than using polar co-ordinates&amp;nbsp; but our machine only has 20mm below&amp;nbsp; X so I've programmed two processes with X reversed on one, both work great if run on there own but will not run as single programme . I can see the issue, it is because I'm using the same tool there is no tool Clarence and no G369&amp;nbsp; Compensation Cancel before it turns it back on&lt;/P&gt;&lt;P&gt;Not sure if this is a post problem or user error&amp;nbsp;&lt;/P&gt;&lt;P&gt;Any help much apricated&amp;nbsp;&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;&lt;A href="https://a360.co/3JeshgB" target="_blank"&gt;https://a360.co/3JeshgB&lt;/A&gt;&lt;/P&gt;</description>
    <pubDate>Tue, 15 Mar 2022 16:49:55 GMT</pubDate>
    <dc:creator>ubi.james13</dc:creator>
    <dc:date>2022-03-15T16:49:55Z</dc:date>
    <item>
      <title>Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11006644#M119125</link>
      <description>&lt;P&gt;Hi, would like to mill a part&amp;nbsp; similar to the attached part using&amp;nbsp; Y axis rather than using polar co-ordinates&amp;nbsp; but our machine only has 20mm below&amp;nbsp; X so I've programmed two processes with X reversed on one, both work great if run on there own but will not run as single programme . I can see the issue, it is because I'm using the same tool there is no tool Clarence and no G369&amp;nbsp; Compensation Cancel before it turns it back on&lt;/P&gt;&lt;P&gt;Not sure if this is a post problem or user error&amp;nbsp;&lt;/P&gt;&lt;P&gt;Any help much apricated&amp;nbsp;&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;&lt;A href="https://a360.co/3JeshgB" target="_blank"&gt;https://a360.co/3JeshgB&lt;/A&gt;&lt;/P&gt;</description>
      <pubDate>Tue, 15 Mar 2022 16:49:55 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11006644#M119125</guid>
      <dc:creator>ubi.james13</dc:creator>
      <dc:date>2022-03-15T16:49:55Z</dc:date>
    </item>
    <item>
      <title>Re: Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11008243#M119163</link>
      <description>&lt;P&gt;At these moves here:&lt;/P&gt;
&lt;LI-CODE lang="general"&gt;G3 Y1.0602 Z0.0224 J0.0598 K0.0199
G1 Y1.12 Z0.0423
G0 X7.1654

(2D CONTOUR2)
M190
G368 X0. Z0. D1. B90. W8
G0 C180.
M189
G1 X7.1654 Y-1.12 Z0.0423 F470.&lt;/LI-CODE&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;P&gt;What is missing from where?&lt;/P&gt;</description>
      <pubDate>Wed, 16 Mar 2022 09:40:19 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11008243#M119163</guid>
      <dc:creator>seth.madore</dc:creator>
      <dc:date>2022-03-16T09:40:19Z</dc:date>
    </item>
    <item>
      <title>Re: Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11008807#M119198</link>
      <description>&lt;P&gt;Hi&amp;nbsp;&lt;a href="https://forums.autodesk.com/t5/user/viewprofilepage/user-id/6965551"&gt;@seth.madore&lt;/a&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Have had a play with programs so attached is a full working hand edited programme and also the original un-edited. I'm guessing the post needs editing to achieve the same results, can you help? Should add although I have used&amp;nbsp; Fusion360 for some years I've never before used for Lathe parts only milling having only programmed Mazatrol lathes so this Fanuc Doosan is proving to be a challenge being new to G code lathe programming and a new machine so forgive me if I seem a bit slow !&lt;/P&gt;</description>
      <pubDate>Wed, 16 Mar 2022 13:29:29 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11008807#M119198</guid>
      <dc:creator>ubi.james13</dc:creator>
      <dc:date>2022-03-16T13:29:29Z</dc:date>
    </item>
    <item>
      <title>Re: Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11009857#M119217</link>
      <description>&lt;P&gt;Hello&amp;nbsp;&lt;a href="https://forums.autodesk.com/t5/user/viewprofilepage/user-id/3330691"&gt;@ubi.james13&lt;/a&gt;,&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;P&gt;I don't know if the tool and spindle blocks have to be reinstated or not.&amp;nbsp; I am attaching your program with just the G369 added, can you let me know if this runs on your machine?&amp;nbsp; If so, you can add a single line to the post to get this output.&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;LI-CODE lang="javascript"&gt;    } else {
      if (getProperty("useG400") &amp;amp;&amp;amp; ((bFormat.getResultingValue(abc.y) == 0) || (Math.abs(bFormat.getResultingValue(abc.y)) == 90))) {
        setSpindleOrientationMilling(abc);
      } else {
        cancelWorkPlane();  // &amp;lt;&amp;lt;&amp;lt; ADD THIS LINE
        var compensationOffset = tool.isTurningTool() ? tool.compensationOffset : tool.lengthOffset;
        var toolAxisMode = (machineState.usePolarMode || machineState.useXZCMode || machineState.axialCenterDrilling) ? 0 : 1;  // D0 = tool axis is Z-axis, D1 = tool axis is X-axis
        gWCSModal.reset();
        writeBlock(
          gWCSModal.format(368),
          "X" + spatialFormat.format(0),
          "Z" + spatialFormat.format(0),
          "D" + spatialFormat.format(toolAxisMode),
          bFormat.format((getSpindle(PART) == SPINDLE_MAIN) ? abc.y : -abc.y), // only B-axis is supported for G368
          "W" + compensationOffset
        );
      }&lt;/LI-CODE&gt;
&lt;P&gt;Please let me know if it works and we will update the library post.&lt;/P&gt;</description>
      <pubDate>Wed, 16 Mar 2022 20:31:44 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11009857#M119217</guid>
      <dc:creator>bob.schultz</dc:creator>
      <dc:date>2022-03-16T20:31:44Z</dc:date>
    </item>
    <item>
      <title>Re: Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11011096#M119245</link>
      <description>&lt;P&gt;Hi&amp;nbsp;&lt;a href="https://forums.autodesk.com/t5/user/viewprofilepage/user-id/3704064"&gt;@bob.schultz&lt;/a&gt;&amp;nbsp;,no my machine definitely needs to&amp;nbsp;&lt;SPAN&gt;reinstate the tool and spindle code, after the G369&amp;nbsp;the upper turret returns to home in X &amp;amp; Y with a spindle stop. The good news is I have found a work-around on the part I'm actually machining for the moment by doing all the work on one side of the part then going back to do other side ! as long as this requires a tool change all code runs straight from post ! &lt;/SPAN&gt;&amp;nbsp;&lt;/P&gt;</description>
      <pubDate>Thu, 17 Mar 2022 11:29:57 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11011096#M119245</guid>
      <dc:creator>ubi.james13</dc:creator>
      <dc:date>2022-03-17T11:29:57Z</dc:date>
    </item>
    <item>
      <title>Re: Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11011364#M119248</link>
      <description>&lt;P&gt;Thanks&amp;nbsp;&lt;a href="https://forums.autodesk.com/t5/user/viewprofilepage/user-id/3330691"&gt;@ubi.james13&lt;/a&gt;,&amp;nbsp;this is good to know.&amp;nbsp; We will get the library post updated.&amp;nbsp; For your information, you can force a tool change using a Manual NC command prior to an operation, which will allow you to program the operations in the desired order.&amp;nbsp; This will also output the G369 code.&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;P&gt;&lt;span class="lia-inline-image-display-wrapper lia-image-align-inline" image-alt="bobschultz_0-1647522646658.png" style="width: 600px;"&gt;&lt;img src="https://forums.autodesk.com/t5/image/serverpage/image-id/1037469iC8FC50C1B47B7C78/image-size/medium?v=v2&amp;amp;px=400" role="button" title="bobschultz_0-1647522646658.png" alt="bobschultz_0-1647522646658.png" /&gt;&lt;/span&gt;&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;</description>
      <pubDate>Thu, 17 Mar 2022 13:12:29 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11011364#M119248</guid>
      <dc:creator>bob.schultz</dc:creator>
      <dc:date>2022-03-17T13:12:29Z</dc:date>
    </item>
    <item>
      <title>Re: Doosan Mill/Turn Y axis milling issues</title>
      <link>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11011931#M119263</link>
      <description>&lt;P&gt;&lt;a href="https://forums.autodesk.com/t5/user/viewprofilepage/user-id/3704064"&gt;@bob.schultz&lt;/a&gt;&amp;nbsp;yeah works a treat !&lt;/P&gt;</description>
      <pubDate>Thu, 17 Mar 2022 16:28:33 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/fusion-manufacture/doosan-mill-turn-y-axis-milling-issues/m-p/11011931#M119263</guid>
      <dc:creator>ubi.james13</dc:creator>
      <dc:date>2022-03-17T16:28:33Z</dc:date>
    </item>
  </channel>
</rss>

