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    <title>topic Convert sheetmetal folded to flat pattern on drawing in Inventor Programming - iLogic, Macros, AddIns &amp; Apprentice</title>
    <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6842933#M69737</link>
    <description>&lt;P&gt;Hi guys,&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;I'm wondering if it is possible to convert drawing views of folded sheet metal parts to a flat pattern view by using iLogic.&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;The reason I'm asking is because we have to place lots of sheet metal on a drawing. When we place a sheet metal part on our drawing, the view option automatically chooses the folded model as default and we have to change it to flat pattern. The reason why this is annoying is because I automated a large part of the sheet metal drawings, but this part still has to be done manually....&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;I hope someone can help me out &lt;img class="lia-deferred-image lia-image-emoji" src="https://forums.autodesk.com/html/@B4D44A73814D7FC0D950DEDFACB97081/emoticons/1f642.png" alt=":slightly_smiling_face:" title=":slightly_smiling_face:" /&gt; &amp;nbsp;&lt;/P&gt;</description>
    <pubDate>Tue, 31 Jan 2017 11:18:26 GMT</pubDate>
    <dc:creator>Anonymous</dc:creator>
    <dc:date>2017-01-31T11:18:26Z</dc:date>
    <item>
      <title>Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6842933#M69737</link>
      <description>&lt;P&gt;Hi guys,&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;I'm wondering if it is possible to convert drawing views of folded sheet metal parts to a flat pattern view by using iLogic.&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;The reason I'm asking is because we have to place lots of sheet metal on a drawing. When we place a sheet metal part on our drawing, the view option automatically chooses the folded model as default and we have to change it to flat pattern. The reason why this is annoying is because I automated a large part of the sheet metal drawings, but this part still has to be done manually....&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;I hope someone can help me out &lt;img class="lia-deferred-image lia-image-emoji" src="https://forums.autodesk.com/html/@B4D44A73814D7FC0D950DEDFACB97081/emoticons/1f642.png" alt=":slightly_smiling_face:" title=":slightly_smiling_face:" /&gt; &amp;nbsp;&lt;/P&gt;</description>
      <pubDate>Tue, 31 Jan 2017 11:18:26 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6842933#M69737</guid>
      <dc:creator>Anonymous</dc:creator>
      <dc:date>2017-01-31T11:18:26Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6843025#M69739</link>
      <description>&lt;P&gt;Hallo Jesse,&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;P&gt;Maybe you can use this:&lt;/P&gt;
&lt;P&gt;SyntaxEditor Code Snippet&lt;/P&gt;
&lt;PRE&gt;&lt;SPAN&gt;Imports&lt;/SPAN&gt; &lt;SPAN&gt;Inventor&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;ViewOrientationTypeEnum&lt;/SPAN&gt;
&lt;SPAN&gt;Imports&lt;/SPAN&gt; &lt;SPAN&gt;Inventor&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;DrawingViewStyleEnum&lt;/SPAN&gt;

&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oDrawingDoc&lt;/SPAN&gt; &lt;SPAN&gt;as&lt;/SPAN&gt; &lt;SPAN&gt;DrawingDocument&lt;/SPAN&gt;    
&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oPartDoc&lt;/SPAN&gt; &lt;SPAN&gt;as&lt;/SPAN&gt; &lt;SPAN&gt;Document&lt;/SPAN&gt;
&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oSheet&lt;/SPAN&gt; &lt;SPAN&gt;As&lt;/SPAN&gt; &lt;SPAN&gt;sheet&lt;/SPAN&gt;
&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oView1&lt;/SPAN&gt; &lt;SPAN&gt;as&lt;/SPAN&gt; &lt;SPAN&gt;DrawingView&lt;/SPAN&gt;
&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oView2&lt;/SPAN&gt; &lt;SPAN&gt;as&lt;/SPAN&gt; &lt;SPAN&gt;DrawingView&lt;/SPAN&gt;
&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oView3&lt;/SPAN&gt; &lt;SPAN&gt;as&lt;/SPAN&gt; &lt;SPAN&gt;DrawingView&lt;/SPAN&gt;
&lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oView4&lt;/SPAN&gt; &lt;SPAN&gt;as&lt;/SPAN&gt; &lt;SPAN&gt;DrawingView&lt;/SPAN&gt; 

&lt;SPAN&gt;ViewScale&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;1&lt;/SPAN&gt;

&lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;Ask to create drawing?&lt;/SPAN&gt;
&lt;SPAN&gt;dwgQuery&lt;/SPAN&gt;&lt;SPAN&gt;=&lt;/SPAN&gt;&lt;SPAN&gt;MsgBox&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;Would you like to Create a drawing for this MODEL?&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;vbYesNo&lt;/SPAN&gt;&lt;SPAN&gt;,&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;Drawing Selection&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt;

&lt;SPAN&gt;If&lt;/SPAN&gt; &lt;SPAN&gt;dwgQuery&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;vbYes&lt;/SPAN&gt; &lt;SPAN&gt;Then&lt;/SPAN&gt;
    &lt;SPAN&gt;oPartDoc&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;ThisDoc&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Document&lt;/SPAN&gt;
    
       
    &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;Check to see if part is a sheetmetal part&lt;/SPAN&gt;
    &lt;SPAN&gt;If&lt;/SPAN&gt; &lt;SPAN&gt;oPartDoc&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;SubType&lt;/SPAN&gt; &lt;SPAN&gt;&amp;lt;&amp;gt;&lt;/SPAN&gt; &lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;{9C464203-9BAE-11D3-8BAD-0060B0CE6BB4}&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt; &lt;SPAN&gt;Then&lt;/SPAN&gt; 
        &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;do nothing &lt;/SPAN&gt;
    &lt;SPAN&gt;Else&lt;/SPAN&gt;
        &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;ensure this part has a flat pattern&lt;/SPAN&gt;
        &lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oSMDef&lt;/SPAN&gt; &lt;SPAN&gt;As&lt;/SPAN&gt; &lt;SPAN&gt;SheetMetalComponentDefinition&lt;/SPAN&gt;
        &lt;SPAN&gt;oSMDef&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;oPartDoc&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;ComponentDefinition&lt;/SPAN&gt;
        &lt;SPAN&gt;If&lt;/SPAN&gt; &lt;SPAN&gt;oSMDef&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;FlatPattern&lt;/SPAN&gt; &lt;SPAN&gt;Is&lt;/SPAN&gt; &lt;SPAN&gt;Nothing&lt;/SPAN&gt; &lt;SPAN&gt;Then&lt;/SPAN&gt; 
        &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;create flat pattern&lt;/SPAN&gt;
        &lt;SPAN&gt;oSMDef&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Unfold&lt;/SPAN&gt;
        &lt;SPAN&gt;oSMDef&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;FlatPattern&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;ExitEdit&lt;/SPAN&gt;
        &lt;SPAN&gt;oSMDef&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;FlatPattern&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;FlipBaseFace&lt;/SPAN&gt;
        &lt;SPAN&gt;Else&lt;/SPAN&gt;
        &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;do nothing&lt;/SPAN&gt;
        &lt;SPAN&gt;End&lt;/SPAN&gt; &lt;SPAN&gt;If&lt;/SPAN&gt; 
    &lt;SPAN&gt;End&lt;/SPAN&gt; &lt;SPAN&gt;If&lt;/SPAN&gt;
        
    
    &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;Define IDW Template File Location&lt;/SPAN&gt;
    &lt;SPAN&gt;oDrawingDoc&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;ThisApplication&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Documents&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Add&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;kDrawingDocumentObject&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;C:\Temp\my template.idw&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;True&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt;
   &lt;SPAN&gt;oSheet&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;oDrawingDoc&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Sheets&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Item&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;1&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt;
    
      &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt; Create a new NameValueMap object&lt;/SPAN&gt;
  &lt;SPAN&gt;Dim&lt;/SPAN&gt; &lt;SPAN&gt;oBaseViewOptions&lt;/SPAN&gt; &lt;SPAN&gt;As&lt;/SPAN&gt; &lt;SPAN&gt;NameValueMap&lt;/SPAN&gt;
  &lt;SPAN&gt;oBaseViewOptions&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;ThisApplication&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;TransientObjects&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;CreateNameValueMap&lt;/SPAN&gt;
 
 &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;True = folded view &lt;/SPAN&gt;
 &lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;False = flat pattern view&lt;/SPAN&gt;
  &lt;SPAN&gt;oBaseViewOptions&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;Add&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;SheetMetalFoldedModel&lt;/SPAN&gt;&lt;SPAN&gt;"&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;False&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt; 
   
&lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;Define 2d view bottom left corner points for four views&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;oPoint1 = ThisApplication.TransientGeometry.CreatePoint2d(9, 10) ' front view&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;oPoint2 = ThisApplication.TransientGeometry.CreatePoint2d(9, 14) ' top view&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;oPoint3 = ThisApplication.TransientGeometry.CreatePoint2d(18, 10)' right view&lt;/SPAN&gt;
&lt;SPAN&gt;oPoint4&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;ThisApplication&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;TransientGeometry&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;CreatePoint2d&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;20&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;18&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt;&lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt; flat pattern&lt;/SPAN&gt;
    
&lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;oBaseView = oSheet.DrawingViews.AddBaseView(oPartDoc,oPoint1, ViewScale,kFrontViewOrientation, kHiddenLineDrawingViewStyle, "My View")&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;oView2 = oSheet.DrawingViews.AddProjectedView(oBaseView,oPoint2, kHiddenLineDrawingViewStyle, ViewScale)&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;oView3 = oSheet.DrawingViews.AddProjectedView(oBaseView,oPoint3, kHiddenLineDrawingViewStyle, ViewScale)  &lt;/SPAN&gt;
&lt;SPAN&gt;oView4&lt;/SPAN&gt; &lt;SPAN&gt;=&lt;/SPAN&gt; &lt;SPAN&gt;oSheet&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;DrawingViews&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;AddBaseView&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;oPartDoc&lt;/SPAN&gt;&lt;SPAN&gt;,&lt;/SPAN&gt;&lt;SPAN&gt;oPoint4&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;ViewScale&lt;/SPAN&gt;&lt;SPAN&gt;,&lt;/SPAN&gt;&lt;SPAN&gt;kDefaultViewOrientation&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;kHiddenLineDrawingViewStyle&lt;/SPAN&gt;&lt;SPAN&gt;,,, &lt;/SPAN&gt;&lt;SPAN&gt;oBaseViewOptions&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt;
&lt;SPAN&gt;End&lt;/SPAN&gt; &lt;SPAN&gt;If&lt;/SPAN&gt;


&lt;SPAN&gt;'&lt;/SPAN&gt;&lt;SPAN&gt;kDefaultViewOrientation = 10753 (Default folded Or flat pattern view)&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatPivotRightViewOrientation = 10767&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatPivotLeftViewOrientation = 10768&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatPivot180ViewOrientation = 10769&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatBacksideViewOrientation = 10770&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatBacksidePivotRightViewOrientation = 10771&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatBacksidePivotLeftViewOrientation = 10772&lt;/SPAN&gt;&lt;SPAN&gt;
'&lt;/SPAN&gt;&lt;SPAN&gt;kFlatBacksidePivot180ViewOrientation = 10773&lt;/SPAN&gt;
&lt;/PRE&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;P&gt;I already changed it a bit, it will now only make a view from the flat pattern from the open sheetmetal part.&amp;nbsp;&lt;/P&gt;</description>
      <pubDate>Tue, 31 Jan 2017 12:25:11 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6843025#M69739</guid>
      <dc:creator>Rob67ert</dc:creator>
      <dc:date>2017-01-31T12:25:11Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6843064#M69741</link>
      <description>&lt;P&gt;Hi Robert,&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Thanks for the quick answer!&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;I already found this piece of code multiple times, but it's not exactly the one I am looking for...&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;What this piece of code does is to open a new drawing and place views of the part which is open at the moment. What I have is multiple sheet metal parts on one drawing (in folded state unfortunately). I already have a piece of code that places a custom view label above each selected view and changes every view to a selected scale.&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;What I want extra is an conversion of the view from sheetmetal folded to sheetmetal flat pattern. If a conversion isn't possible, maybe the code can place a new (flat pattern) view --&amp;gt; delete the already placed folded view --&amp;gt; place label and scale at the new flat pattern view.&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;I hope someone can help me out...&lt;/P&gt;</description>
      <pubDate>Tue, 31 Jan 2017 12:52:30 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6843064#M69741</guid>
      <dc:creator>Anonymous</dc:creator>
      <dc:date>2017-01-31T12:52:30Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845217#M69770</link>
      <description>&lt;P&gt;Hey, how about this:&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;PRE&gt;Dim oDoc As Document = ThisApplication.ActiveDocument
If oDoc.DocumentType &amp;lt;&amp;gt; DocumentTypeEnum.kDrawingDocumentObject Then Exit Sub
For Each oSheet As Sheet In oDoc.Sheets
     If oSheet.DrawingViews.Count = 0 Then Continue For
     For Each oView As DrawingView In oSheet.DrawingViews
          Dim oModel As Document = oView.ReferencedDocumentDescriptor.ReferencedDocument
          If oModel.DocumentSubType.DocumentSubTypeID &amp;lt;&amp;gt; "{9C464203-9BAE-11D3-8BAD-0060B0CE6BB4}" Then Continue For
          Dim oOptions As NameValueMap = ThisApplication.TransientObjects.CreateNameValueMap
          oOptions.Add("SheetMetalFoldedModel", False)
          Dim oPoint As Point2D = oView.Position
          Dim oViewStyle As DrawingViewStyleEnum = oView.ViewStyle
          Dim oScale As Double = oView.Scale
          Dim oOri As ViewOrientationTypeEnum = ViewOrientationTypeEnum.kDefaultViewOrientation
          oSheet.DrawingViews.AddBaseView(oModel, oPoint, oScale, oOri, oViewStyle, , , oOptions)
          oView.Delete()
     Next
Next&lt;/PRE&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;</description>
      <pubDate>Wed, 01 Feb 2017 06:32:28 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845217#M69770</guid>
      <dc:creator>Owner2229</dc:creator>
      <dc:date>2017-02-01T06:32:28Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845467#M69774</link>
      <description>&lt;P&gt;Hi Mike!&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Thank you very much for the answer. I adjusted your code a little bit so it will work for selected views only. I hope this might be useful for others.&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;PRE&gt;Dim oDoc As Document = ThisApplication.ActiveDocument
If oDoc.DocumentType &amp;lt;&amp;gt; DocumentTypeEnum.kDrawingDocumentObject Then Exit Sub

Dim oView As DrawingView
Dim oSSet As SelectSet = ThisDoc.Document.SelectSet
If oSSet.count = 0 Then
	MessageBox.Show("Select view(s)", "Attention!")
Exit Sub
End If

For Each oSheet As Sheet In oDoc.Sheets
     If oSheet.DrawingViews.Count = 0 Then Continue For
     For Each oView In oSSet
          Dim oModel As Document = oView.ReferencedDocumentDescriptor.ReferencedDocument
          If oModel.DocumentSubType.DocumentSubTypeID &amp;lt;&amp;gt; "{9C464203-9BAE-11D3-8BAD-0060B0CE6BB4}" Then Continue For
          Dim oOptions As NameValueMap = ThisApplication.TransientObjects.CreateNameValueMap
          oOptions.Add("SheetMetalFoldedModel", False)
          Dim oPoint As Point2D = oView.Position
          Dim oViewStyle As DrawingViewStyleEnum = oView.ViewStyle
          Dim oScale As Double = oView.Scale
          Dim oOri As ViewOrientationTypeEnum = ViewOrientationTypeEnum.kDefaultViewOrientation
          oSheet.DrawingViews.AddBaseView(oModel, oPoint, oScale, oOri, oViewStyle, , , oOptions)
          oView.Delete()
     Next
Next&lt;/PRE&gt;</description>
      <pubDate>Wed, 01 Feb 2017 10:04:51 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845467#M69774</guid>
      <dc:creator>Anonymous</dc:creator>
      <dc:date>2017-02-01T10:04:51Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845565#M69775</link>
      <description>&lt;P&gt;Hi Mike,&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Just one more question. Right now, when i have more than one sheet, all the new views are placed on the first sheet. I would like the new views to be placed on the sheet where the folded model is placed...&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Is this possible?&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Thx in advance&lt;/P&gt;</description>
      <pubDate>Wed, 01 Feb 2017 11:01:56 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845565#M69775</guid>
      <dc:creator>Anonymous</dc:creator>
      <dc:date>2017-02-01T11:01:56Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845648#M69777</link>
      <description>&lt;P&gt;Do&amp;nbsp;you want to select the views that should be processed&amp;nbsp;for each sheet?&lt;/P&gt;
&lt;P&gt;If so, you have to move the selection pick to the "For each sheet" loop and prompt user for input.&lt;/P&gt;
&lt;P&gt;I don't see how you could pre-select views from multiple sheets... do you want to only select the views from first sheet and process all views from all the other sheets?&lt;/P&gt;
&lt;P&gt;Or is there a condition for the views that we could code in?&lt;/P&gt;</description>
      <pubDate>Wed, 01 Feb 2017 11:55:04 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845648#M69777</guid>
      <dc:creator>Owner2229</dc:creator>
      <dc:date>2017-02-01T11:55:04Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845749#M69779</link>
      <description>&lt;P&gt;What i basically want to happen is the following;&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;OL&gt;&lt;LI&gt;Manually place folded parts on drawing (lets say on sheet 2)&lt;/LI&gt;&lt;LI&gt;Select all the folded parts views on sheet 2&lt;/LI&gt;&lt;LI&gt;Run the rule to add the flat pattern of the parts on the same sheet as the folded views and delete the folded views&lt;/LI&gt;&lt;/OL&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;What is happening with the code i mentioned above;&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;OL&gt;&lt;LI&gt;Manually place folded parts on drawing (lets say on sheet 2)&lt;/LI&gt;&lt;LI&gt;Select all the folded parts views on sheet 2&lt;/LI&gt;&lt;LI&gt;Run the rule&lt;/LI&gt;&lt;LI&gt;Flat pattern of the parts are created and placed on &lt;U&gt;sheet 1&lt;/U&gt;&amp;nbsp;and the folded views are deleted (not what i want)&lt;/LI&gt;&lt;/OL&gt;&lt;P&gt;So, is there a way to direct the new view to the sheet and position of the original folded view?&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Could you maybe give a direction in the following sentence?&lt;/P&gt;&lt;PRE&gt;&lt;SPAN&gt;oSheet&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;DrawingViews&lt;/SPAN&gt;&lt;SPAN&gt;.&lt;/SPAN&gt;&lt;SPAN&gt;AddBaseView&lt;/SPAN&gt;&lt;SPAN&gt;(&lt;/SPAN&gt;&lt;SPAN&gt;oModel&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;oPoint&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;oScale&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;oOri&lt;/SPAN&gt;&lt;SPAN&gt;, &lt;/SPAN&gt;&lt;SPAN&gt;oViewStyle&lt;/SPAN&gt;&lt;SPAN&gt;, , , &lt;/SPAN&gt;&lt;SPAN&gt;oOptions&lt;/SPAN&gt;&lt;SPAN&gt;)&lt;/SPAN&gt;&lt;/PRE&gt;&lt;P&gt;&amp;nbsp;Or is there an other way to do it?&lt;/P&gt;&lt;P&gt;&amp;nbsp;&lt;/P&gt;&lt;P&gt;Greetings&lt;/P&gt;</description>
      <pubDate>Wed, 01 Feb 2017 12:33:21 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845749#M69779</guid>
      <dc:creator>Anonymous</dc:creator>
      <dc:date>2017-02-01T12:33:21Z</dc:date>
    </item>
    <item>
      <title>Re: Convert sheetmetal folded to flat pattern on drawing</title>
      <link>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845787#M69780</link>
      <description>&lt;P&gt;Alright, here you go. The rule will now only process the selected views on the active sheet and only if the source model is a sheet metal (that's the document type check).&lt;/P&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;
&lt;PRE&gt;Dim oDoc As Document = ThisApplication.ActiveDocument
If oDoc.DocumentType &amp;lt;&amp;gt; DocumentTypeEnum.kDrawingDocumentObject Then Exit Sub

Dim oView As DrawingView
Dim oSSet As SelectSet = ThisDoc.Document.SelectSet
If oSSet.count = 0 Then
     MessageBox.Show("Select view(s)", "Attention!")
     Exit Sub
End If

Dim oSheet As Sheet = oDoc.ActiveSheet
If oSheet.DrawingViews.Count = 0 Then Continue For
For Each oView In oSSet
     Dim oModel As Document = oView.ReferencedDocumentDescriptor.ReferencedDocument
     If oModel.DocumentSubType.DocumentSubTypeID &amp;lt;&amp;gt; "{9C464203-9BAE-11D3-8BAD-0060B0CE6BB4}" Then Continue For
     Dim oOptions As NameValueMap = ThisApplication.TransientObjects.CreateNameValueMap
     oOptions.Add("SheetMetalFoldedModel", False)
     Dim oPoint As Point2D = oView.Position
     Dim oViewStyle As DrawingViewStyleEnum = oView.ViewStyle
     Dim oScale As Double = oView.Scale
     Dim oOri As ViewOrientationTypeEnum = ViewOrientationTypeEnum.kDefaultViewOrientation
     oSheet.DrawingViews.AddBaseView(oModel, oPoint, oScale, oOri, oViewStyle, , , oOptions)
     oView.Delete()
Next&lt;/PRE&gt;
&lt;P&gt;&amp;nbsp;&lt;/P&gt;</description>
      <pubDate>Wed, 01 Feb 2017 12:46:46 GMT</pubDate>
      <guid>https://forums.autodesk.com/t5/inventor-programming-ilogic/convert-sheetmetal-folded-to-flat-pattern-on-drawing/m-p/6845787#M69780</guid>
      <dc:creator>Owner2229</dc:creator>
      <dc:date>2017-02-01T12:46:46Z</dc:date>
    </item>
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