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Unequal bilateral profile tolerancing, how do I put it on a drawing

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archer183
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Unequal bilateral profile tolerancing, how do I put it on a drawing

see here: http://www.tec-ease.com/tips/october-05.htm we are using the ASME Y14.5 standard note.

How do I create that type of feature control frame with the offset lines and double arrows in a drawing in inventor 2010?

thanks
Greg
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Anonymous
in reply to: archer183

Greg,

There is no way to do this automatically. But you can do this manually.

1. Create your drawing.
2. Create your view.
3. Create a view sketch (you can tell if it is a view sketch because the
coordinate system shows up at the center of the view or the sketch in the
browser is a child of the view). Just make sure you have the view selected
before selecting the Sketch command.
4. Project the edge(s).
5. Offset the edge(s) in both directions.
6. Select the offset curve(s), show the context menu (RMB), select
Properties, change the line type.
7. Finish the sketch.
8. Create a dimension, using the option (on the context menu) to put the
arrowheads on the outside.
9. Create the feature control frame with the desired symbols and values.
When placing the FCF, place it right on the dimension value.
10. If necessary, manipulate the leader on the FCF so that it does not
exist. Basically you are shrinking it down to nothing.
11. Select the dimension, show the context menu, select the Edit command.
On the Text page Hide the Dimension Value.
12. You should see for the dimension. Select the dimension, show
the context menu, select the Text command. Put a blank space (hit the space
bar on your keyboard) in the edit box. The string will disappear.

Hope this helps...

Regards,
Diane Hawes
Autodesk, Inc.

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