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see through part

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Message 1 of 21
dane_m_steyne
7100 Views, 20 Replies

see through part

attached is 2013 sample part...how would i make the section of the tank glass so that i can see inside the tank...picture attached

Dane

20 REPLIES 20
Message 2 of 21
JDMather
in reply to: dane_m_steyne

One possible solution - examine technique and the delete student version file.

 


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Message 3 of 21
WHolzwarth
in reply to: dane_m_steyne

Well, that's another big mystery for me, with 2013 appearances.

 

Here's a workaround

Walter

Walter Holzwarth

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Message 4 of 21
dane_m_steyne
in reply to: WHolzwarth

very clever indeed....thanks to you both

 

Dane

Message 5 of 21
JDMather
in reply to: dane_m_steyne

Search here for Clear&.bmp for another possible solution (I haven't tried it in 2013).


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Message 6 of 21
dane_m_steyne
in reply to: JDMather

I was looking at Walters solution and the bit i cannot seem to follow is the Surface 1 and Delete Face 2  ... how did you create the Surface 1 feature please?

Dane

Message 7 of 21
rdyson
in reply to: dane_m_steyne

I suspect he used Copy Object (3DModel>Modify) 



PDSU 2016
Message 8 of 21
WHolzwarth
in reply to: rdyson

That's right, Ray

Walter Holzwarth

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Message 9 of 21
dane_m_steyne
in reply to: WHolzwarth

Thank you

Message 10 of 21
WHolzwarth
in reply to: dane_m_steyne

Hmm. I must admit, that I didn't realize it before, but I thought, that you could select in former releases some faces in a non-transparent part and give them a transparent color. But it seems, that this never was possible in the past.

 

There are two possibilities:

 

1. Main color of part is non transparent. If some faces are changed to a normally transparent color, they remain opaque. No transpareny at all.

2. Main color of part is transparent. Even if some faces are changed to a non-transparent color, color change occurs, but the new color stays transparent, too.

 

Well, that's a wish for 2014:

Independent face switching from opaque to transparent or vice versa in single body IPTs.

 

Walter

Walter Holzwarth

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Message 11 of 21
dane_m_steyne
in reply to: WHolzwarth

I want to use the tank in an assembly....i need 1 view as normal and the other view as see through..would i need to use View Representation to accomplish this

 

Thanks

Dane

Message 12 of 21
JDMather
in reply to: dane_m_steyne

Yes


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Message 13 of 21
dan_inv09
in reply to: WHolzwarth

If you make the clear portion a new Solid Body and change the appearance for the Solid.

It still won't work if you change the appearance for the feature, it has to be changed for the Solid.

 

I thought maybe for this case you might be trying to use a Split face or something - I just checked and Split can be used to make separate bodies (in my case though, the widow I cut was the old Solid and the whole rest of the part became the new Solid, who knows what fun that might cause.)

Message 14 of 21
billyb
in reply to: dan_inv09

My approach, similar to Walter's, however, I split the cylindrical faces (outside and inside) with a 3D sketch intersection and assigned the split faces a clear glass appearance.

 

On the view tab I set Shadows: All and Visual Style to Realistic, then allowed the ray tracing to complete its "good" pass.

 

The resulting image is attached.

 

Bill Bogan
- Providing freelance visualization
- Inventor: Expert
- Revit: Novice and growing...
Message 15 of 21
billyb
in reply to: billyb

After a little more investigation, the best way to do this and present the component as one part is using Multi-body parts. The completed part is attached.

 

  1. Edit the part.
  2. Create a sketch defining the cutout. The sketch will be extruded to create a surface.
  3. Using the extrude command select the cutout sketch as the profile. Then specify the To sketch/face termination.
  4. Select the interior chamber face.
  5. Set the dialog box so that it creates a surface not a solid. Click OK.
  6. Activate the split tool.
  7. Select the cutout surface. Then, select the chamber.
  8. Click the Solid option (bottom left button) on the Split dialog box.
  9. Click OK. You should have two solids.
  10. Create two part view representations. Name the first Solid and the second Transparent.
  11. Save the file, but don't close it.
  12. Activate the Transparent view rep.
  13. In the part browser, expand the Solid Bodies node. Select the 2nd node. That should be the cutout.
  14. In the QAT, change the appearance to Clear - Light (in the Inventor Appearance Library).
  15. Save the file again.

That should do it for you.

-Bill

 

 

 

 

Bill Bogan
- Providing freelance visualization
- Inventor: Expert
- Revit: Novice and growing...
Message 16 of 21
WHolzwarth
in reply to: dane_m_steyne

That did it, Bill. But are you really pleased with the result?

 

If a face of the main body is selected,and the same transparent color as used in the cutout is applied, no transparency occurs. That's confusing.

 

Walter

 

 

Walter Holzwarth

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Message 17 of 21
dan_inv09
in reply to: WHolzwarth

8. Click the Solid option (bottom left button) on the Split dialog box.

9. Click OK. You should have two solids.

 

13. In the part browser, expand the Solid Bodies node. Select the 2nd node. That should be the cutout.

14. In the QAT, change the appearance to Clear - Light (in the Inventor Appearance Library).

 

The face won't work, it has to be changed for the solid.

Message 18 of 21
billyb
in reply to: WHolzwarth

Correct Walter, you can't do that. I tried that and it didn't work.

So, it appears Inventor has a limitation in that it cannot correctly represent both transparent and opaque faces in the same body.

 

I can select the other body, the first one (main vessel shape) and apply the transparent appearance to that - see attached. But it must be the whole body.

Bill Bogan
- Providing freelance visualization
- Inventor: Expert
- Revit: Novice and growing...
Message 19 of 21
WHolzwarth
in reply to: billyb

Yes, Bill. That's state-of-the-art.

 

Smiley Wink But it shouldn't last too long for the future.

Walter Holzwarth

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Message 20 of 21
billyb
in reply to: WHolzwarth

That is no longer something for me to confirm or deny... Smiley Indifferent

Bill Bogan
- Providing freelance visualization
- Inventor: Expert
- Revit: Novice and growing...

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