Populating iProperties at Project level

[Anonymous]

I've just been going through filling in the iProperties in my latest project so that they in turn populate my drawing title blocks and realised that some fields remain the same for every part and assembly (Company and Project to be exact).  Is there any way to populate these fields at a project level so that I don't have to keep typing them in, or should this be posted in the Ideastation?

[rhasell · Accepted solution]

Hi

Use the Design Assistant to copy the properties.

Basic Proceedure:

Make the changes to the GA.

Close and save the file.

Ensure no files are open.

File open dialog box, RMB on the GA, select "Design Assistant"

Click on Properties.

RMB on the GA

Select "Copy Design Properties"

Select the iProperties you wish to copy.

Selct the files

Click on "copy"

All done.

[Curtis_Waguespack]

Hi spackle42,

In addition to the Design Assistant, you can copy iProperties from one component to others using the Bill Of Materials editor. Changes made in the assembly BOM as pushed down into the component files.

Simply add the iProperties to the BOM grid, then select the iProperty cell value to be copied, and then select the cells to copy to, and paste.

Additionally, you can Copy/Fill the cells much like you would do in Excel:

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

[dan_inv09]

I've also made lists in Excel and copied right over: if (using your graphic) we pretend that your Mark Number needs to be something like UX950-01 through UX950-09, you can do the incrementing with Excel and then paste it into the BOM editor.

[The_Angry_Elf]

Some great options have been posted for you here but if I understand you correctly, there is one other way you can do some of these.

You posted that some of the properties are company related, dare I assume that for these you know you can populate them into your template files?

Let's say you have a specific part that based on company standards is always, always made out of Stainless Steel, create a template file where the Material is set to Stainless Steel and poof, you're done. Everytime that template is used to create a part, the associated properties are automatically populated accordingly based on that material. You can use the very same appraoch for other templates you may need. Again, this may not solve all your issues, but I think a combo of this and the options posted here, you can do what you need to have done.