Inventor General Discussion

Reply
Member
DosSantosIntl
Posts: 4
Registered: ‎10-15-2012
Message 1 of 11 (438 Views)
Accepted Solution

Long extrusions

438 Views, 10 Replies
01-09-2013 02:06 PM

I have a problem that has come up a few times before in my work.  We design long overland conveyors that can be kilometers long.  In two separate instances, I have extruded a profile along a path that is a few hundred meters long with no problem.  However, when the path gets to around 700 meters, the extrusion that worked fine at 600 meters simply falls apart.  Any idea what is going on?  Does Inventor seriously have a limitation to length of an extrusion?

In Inventor 2012 and earlier versions, the extrusion length is limited to 1 km (= 1000000 mm) for one direction and 2 km for both directions.  Good news is that this limitation no longer exists in Inventor 2013.

 

Four examples are attached here.

 

  • extrude_1km_inv2012.ipt:  Extrusion in one direction.  Changing the extrusion length to 1000001 mm in Inventor 2012 will cause the extrusion to fail.
  • extrude_2km_inv2012.ipt:  Extrusion in both directions.  Changing the extrusion length to 2000001 mm in Inventor 2012 will cause the extrusion to fail.
  • extrude_7km_inv2012_wkaround.ipt:  Using Rectangular Pattern, the desired distance can be achieved. "len" is the parameter for the extrusion length.
  • extrude_7km_inv2013.ipt:  Extruding 7 km in one direction.  In Inventor 2013, the 1 km limitation no longer exists.

Note:  If you open extrude_1km_inv2012.ipt in Inventor 2013 and change the extrusion length to 1000001 mm, the extrusion will still fail because the existing feature uses the old compute method.  To use the new compute method, you need to recreate the extrusion feature (i.e., Delete the existing feature, leaving the base sketch intact, and then create a new extrusion).

 

I looked at DosSantosIntl's model.  After I recreated the extrusion in Inventor 2013, I could extrude the profile by 1000000 meters, well above 671 meters.

 

Glenn

ASM Development

Mentor
RobJV
Posts: 557
Registered: ‎07-14-2004
Message 2 of 11 (424 Views)

Re: Long extrusions

01-09-2013 03:24 PM in reply to: DosSantosIntl

I am personally not aware of a length limit but what does "fall apart" mean?

*Expert Elite*
Curtis_Waguespack
Posts: 2,955
Registered: ‎03-08-2006
Message 3 of 11 (419 Views)

Re: Long extrusions

01-09-2013 03:37 PM in reply to: DosSantosIntl

Hi DosSantosIntl,

 

See the reply from Johnson Shiue at this link:

http://forums.autodesk.com/t5/Autodesk-Inventor/Limits-of-an-Inventor-part-or-assembly/m-p/2642607#M...

 

I'm not aware of a solution, but it might help you find a workaround such as making your long parts in sections.

 

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com



  solution.png  Did you find this reply helpful ? If so please use the Accept as Solution or  Kudos button below.





Mentor
RobJV
Posts: 557
Registered: ‎07-14-2004
Message 4 of 11 (410 Views)

Re: Long extrusions

01-09-2013 04:01 PM in reply to: Curtis_Waguespack

Interesting - learned something new.  Glad I don't design anything that long.  Any reason it can't be broken up into multiple subs as Curtis suggested?

Member
DosSantosIntl
Posts: 4
Registered: ‎10-15-2012
Message 5 of 11 (396 Views)

Re: Long extrusions

01-09-2013 05:26 PM in reply to: DosSantosIntl

Sorry, should have been a bit more specific.  By "falls apart", I mean that an attempt at the extrusion results in an error and the extrusion does not complete.  I can post the exact error message when I pull the model back up at the office tomorrow.

 

Based on the other posts though, it looks like Inventor just has a very small (for my industry) limit to part sizes.  I broke up the length on a previous part that was just for a proposal, but considering this is a continuous belt, it sure seems to me that it should be a single continuous part in my modeling software.  I'd really rather not fudge my way through this project as it is paid work.  I suppose I'll have to revert back to AutoCAD if there are no better solutions, but it's sad to know that the software limits modeling capabilities in such an arbitrary way.

 

If anyone has any other solutions, please let me know.

Valued Mentor
BLHDrafting
Posts: 350
Registered: ‎10-12-2012
Message 6 of 11 (381 Views)

Re: Long extrusions

01-09-2013 08:21 PM in reply to: DosSantosIntl

Not sure if it would make any difference but try changing the part (belt) Units/>Length to metres. I just modelled a simple extrusion 700 metres long without troubles. Worth a try? Best of luck.

Brendan Henderson

Web www.blh.com.au
Twitter @BLHDrafting

Windows 7 x64 -64 GB Ram, Intel Xeon E5-1620 @ 3.6 GHz
ATI FirePro V7800 2 GB, 180 GB SSD & 1 TB HDD, Inv R2013 PDS Premium SP2 Update 3 (Build 200), Vault 2013 Workgroup Update 2 (Build 17.2.9.0)
Valued Mentor
rhasell
Posts: 327
Registered: ‎05-23-2007
Message 7 of 11 (370 Views)

Re: Long extrusions

01-09-2013 10:15 PM in reply to: BLHDrafting

Hi

 

I did the same, no issues. (The display gets a bit jumpy)

 

My part is 7KM long and shown below is a 50mm dia hole at the 7km mark.


LONG EXTR-2.JPG


Reg
Autodesk PDS Ultimate 2015 SP 1 Build 203
Intel Core i7 (950@3.07GHz)/Win7x64 (Home) - 12GB Ram
Nvidia GeForce GTX 560 Ti
 
Please Give Kudo's / accept as a solution if it solves your problem.
Member
DosSantosIntl
Posts: 4
Registered: ‎10-15-2012
Message 8 of 11 (342 Views)

Re: Long extrusions

01-10-2013 07:18 AM in reply to: rhasell

Nope, that didn't do it (changing units to meters)

 

It's somewhere between 671 meters and 672 meters that the extrusion fails.  Complete text of the error message is:

 

Slope Conveyor Belt.ipt:Errors occurred during update

     BeltLine: Could not build this Extrusion

          The specified inputs did not create sweep geometry (faces and/or edges). Try by changing path geometry and/or creating the profile on a sketch plane that is perpendicular to the path and contains one of the path vertices.

     LOBDischXition: Could not build this Loft

 

As annoyed as I am by the fact that Inventor is incapable of creating this extrusion, it seems like they could at least offer an error message that actually explains the problem.  Something along the lines of "This extrusion is too long.  Inventor cannot create a part this big" would work.

 

One thing that I think may make the difference (and what allowed the other posters to create a 7km extrusion) is that my profile does not coincide with the extrusion path.  I may try to change that to make this work, but doing so changes the intent of my design, and I really grudge modifying my design to accommodate the software.

 

I appreciate the suggestions offered so far!  If anyone else has any ideas, please keep them coming!

Employee
GlennChun
Posts: 115
Registered: ‎06-10-2004
Message 9 of 11 (282 Views)

Re: Long extrusions

01-11-2013 03:53 PM in reply to: DosSantosIntl

In Inventor 2012 and earlier versions, the extrusion length is limited to 1 km (= 1000000 mm) for one direction and 2 km for both directions.  Good news is that this limitation no longer exists in Inventor 2013.

 

Four examples are attached here.

 

  • extrude_1km_inv2012.ipt:  Extrusion in one direction.  Changing the extrusion length to 1000001 mm in Inventor 2012 will cause the extrusion to fail.
  • extrude_2km_inv2012.ipt:  Extrusion in both directions.  Changing the extrusion length to 2000001 mm in Inventor 2012 will cause the extrusion to fail.
  • extrude_7km_inv2012_wkaround.ipt:  Using Rectangular Pattern, the desired distance can be achieved. "len" is the parameter for the extrusion length.
  • extrude_7km_inv2013.ipt:  Extruding 7 km in one direction.  In Inventor 2013, the 1 km limitation no longer exists.

Note:  If you open extrude_1km_inv2012.ipt in Inventor 2013 and change the extrusion length to 1000001 mm, the extrusion will still fail because the existing feature uses the old compute method.  To use the new compute method, you need to recreate the extrusion feature (i.e., Delete the existing feature, leaving the base sketch intact, and then create a new extrusion).

 

I looked at DosSantosIntl's model.  After I recreated the extrusion in Inventor 2013, I could extrude the profile by 1000000 meters, well above 671 meters.

 

Glenn

ASM Development

Autodesk T-Splines Component Development
Member
DosSantosIntl
Posts: 4
Registered: ‎10-15-2012
Message 10 of 11 (234 Views)

Re: Long extrusions

01-14-2013 01:34 PM in reply to: GlennChun

This workaround will do it.  Incidentally, I found that in order to make the return belt work (separate feature that is also about 2km long), I only had to break up the lines that composed the path into 500m increments.  The sweep then generated as a single 2km feature.

 

Thanks for your help everyone.  This is the first time I've posted here to ask for help, and I'm very pleased at everyone's helpful responses.

Post to the Community

Have questions about Autodesk products? Ask the community.

New Post
Need installation help?

Start with some of our most frequented solutions or visit the Installation and Licensing Forum to get help installing your software.