Worked like a champ. I was using two sections and
essentially three rails, whereas you were using three
sections and two rails. On occasion, I was able to get a
surface with my approach, but could not thicken it to the
required thickness. Thanks!. Jon
Glenn Chun (Autodesk, Inc.) wrote:
> Jon,
>
> Inventor 8 can create a loft surface and thicken it with no problem.
>
> Please try the following steps:
>
> 1. Open the Carbon_Elevation_Loft.ipt in Inventor 8.
> 2. Delete the Sketch107 (The sketch is unnecessary).
> 3. Delete the Sketch106 (The sketch is unnecessary).
> 4. Invoke the Loft tool.
> 5. Press the Surface button.
> 6. Click on "Click to add" in the Section list.
> 7. Click two edges for first section (See the attached screenshot).
> 8. Click on "Click to add" in the Section list.
> 9. Click two edges for second section (See the attached screenshot).
> 10. Click on "Click to add" in the Rail list.
> 11. Click the Sketch96.
> 12. Click the Sketch105 (The projected line is unnecessary, but it's okay to
> keep it).
> 13. Hit the OK button.
> 14. Invoke the Thicken tool.
> 15. Select the Quilt option.
> 16. Select the Loft Surface in the graphics window.
> 17. Enter "0.094 in" for distance.
> 18. Press the Second arrow button (to flip the thicken direction).
> 19. Hit the OK button
> 20. Turn off the visibility of the Loft Surface.
>
> You should see a model like the attached screenshot.
>
> HTH,
> Glenn
>
> "Jon B. Jacob" wrote in message
> news:41fe4735_1@newsprd01...
>
>>The attached drawing shows the surface that I would like. By
>>replacing the 2-line rail with a single line, I was able to
>>loft a surface and thicken it without errors.
>>
>>With some variations, a surface loft was created OK. But
>>when it was thickened to the same thickness as the adjoining
>>solids, tangency errors would result. If it was thickened to
>>1/2 the thickness, it would work as well as thickening the
>>wrong direction.
>>
>>If you are running IV9, I would be curious if this example
>>works.
>>
>>Thanks.
>
>
>