Sorry to tell you that your advice does not resolve the issue here.
I have many assembly models in Inventor 2012 and 2013 which open in Master rep. view / master LOD
and there is no evidence of work planes on the assy. when I open it.
So to say that assy. saved to master Rep. view will always show ALL is misleading.
I compare this situation to having a large AutoCAD drawing with say hundreds of layers for all the different trades in a large institutional building.
What if every time you open it all the **** layers came on ! And you were then expected to start suppressing layers before you could work with the drawing.
Bottom line is the template from the box opens with Master Rep. view active and locked.
Plus the LOD is set to Master.
Where does switching to Default Rep. view come into all this.
Tried all of the above ! Still stucj with an assembly and sub's which open with all work features vissible.
ie Master Rep. active, locked and controlling everything below it.
Tried all of the above ! Still stuck with an assembly and sub's which open with all work features vissible.
ie Master Rep. active, locked and controlling everything below it.
I know that view reps seem frustrating (to say the least), but let me make a few points about what you have said.
1. "Master Rep. active, locked and controlling everything below it".... The Master View rep (VR) does not control anything below it. The master view rep is locked and will show EVERYTHING... every part and every workplane, work axis, workpoint..etc.
Probably the most important things that new users miss is this:
a. VR control the visibility of parts and planes and other things. You can can use it to control the color or visibility of parts. If you want the part suppressed, then use LOD... not VR.
b. When you place a sub into an assembly, it will come in as the Master VR. If you have defined a Default (or other) VR in the sub, activate it by right-clicking it in the assembly browser and choosing "Representations". In the Representations dialog, change the Master to Default (or other). Now, if you want this VR to automatically change if/when you make edits to the way its defined in the sub, check the "Associative" box here.
c. When you "Open" a sub, it will open in "Default" VR. Even if you have defined different ones and save the assembly last with one of them active.... it still opens in the default VR. There is a catch to this... if you have renamed the Default VR, then it will open with the VR that was active on the last time it was SAVED.
d.You can use the View> Object visibility panel to temporarily turn off all the work planes /axis/points in the Master VR, but you cant save it. If you want one with them all turned off, create a new VR and turn them off in that one. You can save it then... as long as you dont lock it.
e. Once you have a view rep EXACTLY the way you want it... Lock it. Then, if a part/iam is added to the iam, it will not be included in the VR.
Thank you for the detailed list of how the reps work. It will help when I have to use them. I know that for those of you who have used the software for some time these things are clear and second nature. But when I was using "that software which shall remain unnamed" We would call these options Work-Arounds that were long winded multistep methods to get around a poorly preforming feature that should have taken only a click or two. Yes there are many work-arounds needed there, it's just that they seem to be built into the software as a good idea here. This array of reps and LODs and such is a prime example.
These are not work-arounds.... just the way it works. In order to activate a VR in an assembly, it takes no more than 4 clicks to activate it.
Watch this video.
Here's a quick start video.
I guess that is my point, to me, they "seem" like work arounds. Maybe it is a case of "absence making the heart grow fonder" as I have been away from SW for over a year and I don't remember things being this difficult. That being said, I am starting to get this area figured out and it isn't as bad as I once thought, just a different way of thinking about things.
No, A work around would be more like having to reset the sketch origon everytime you edit a model and the edges move or change. Set the bloddy origin at the model origen and be done with it! but I guess that my having to manually set it there with every sketch is a "work around" isn't it.
Sorry for the rant at the end. I just had to do it again for a part that needed modifications.
I should say that I also have fond memories of Pre- WildFire Pro-E so maybe I have a very selective memory.
Some great points raised and well explained Karthir1 .
I will be more explicate this time:
I was talking of the effect Master View Representation has on my ability or non ability to save my model assembly and then subsequently open said sub- assy. with no work features showing on the screen.
L.O.D 's work just fine for me within the master Rep. View. I did not allude to them as an isuue.
My problem is that even if I create a new V.R. - Activate it - Lock it then save and open.
My main Assembly always comes in with Master V.R. as default - locked and my myriad of
work features loaded again on to the screen.
There is no way for me to ever suppress a work feature and save in master V.P. mode.
I constantly get the error: “ The current design view representation is locked. Changes made against it will not be saved. If you want to keep those changes, create a new design representation, or unlock the current one “
Just for the records I am now looking at a fairly large mechanical assembly model (100) parts
Opened on my system (version 2013 x 64– Windows 7 Pro X 64) at present in this configuration.
1) In master V.R. – active and locked
2) All LOD’s Master
3) My browser filter “allowing all work features”
4) View object visibility = All features ON
5) In browser under each *.iam the Representation views are all set to Master, assoc. greyed out.
And not one work feature in sight.
Please note that this assembly was created in Version 2012 !
To sum up ! are we all doing this each and every day we open assembly or sub.
Clicking on the View – Visibility – all Features off.
If so, let me tell you that as soon as you create one additional feature to that assy.
All legacy features in your model will pop back on again.
Beginning to think Solid Works WAS the way to go after all !
Thanks for placing the short video clip for us.
After viewing it I am seeing how this component should be handled after all.
Perhaps the open - options- then choose your "Default" V.R. to open from might work after all.
Seems flexibility is the keyword here.
I never used to bother opening my assemblies in this mode with prior versions.
But if it gives the user better, smarter options I am not averse to any of that.
Thanks again !
This doesn't match my experience at all.
New assembly files open with the Default view rep active, and that's what is used by default whenever they're placed in a higher level assembly. Work features turned on or off in the subassemby's Default view rep are respected by the main assembly.
Is it possible that your assembly template(s) just needs to have the Default view rep activated so that's what is normally used? I have not messed with view reps in our templates, so that's the way they come from Autodesk by default.
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