I did a revolve extrusion and I can't get rid of what was left..help?
Is something like this what you are trying to do?
The CADWhisperer YouTube Channel
yes! thank you.. I have been trying to figure out how to use the sculpt tool but haven't found any good tutorials? would you happen to have any good sources for this?
http://home.pct.edu/~jmather/content/DSG322/Inventor%20Tutorials/Inventor%2011%20Tutorial%206.pdf
http://home.pct.edu/~jmather/content/DSG322/Inventor%20Tutorials/Inventor%202011%20Tutorial%2014.pdf
But I noticed that your first sketch isn't constrained and I doubt that it is really correct.
You might start here
http://home.pct.edu/~jmather/SkillsUSA%20University.pdf
The CADWhisperer YouTube Channel
ty..i've been reading the material you've provided but I'm still uanble to use sculpt properly without cutting my material in places I don't want..I am trying to use it using work-planes but when i went back to see how you did it I noticed that you use the direct edit option of offsetting..I was wondering how you were able top do this using that feature? thank you!
@luz_wyatt wrote:
1. I noticed that you use the direct edit option of offsetting..
2. I was wondering how you were able top do this using that feature?
1. I don't know what direct edit option is - can you post screen shot?
2. Not sure what this means, did you leave out a word or letter in the sentance - can you post a screen shot?
(I do better with pictures, or better yet, files - than words.)
The CADWhisperer YouTube Channel
sorry..I meant I don't you know how you were able to use that..I was trying to follow your steps using the feature tree but all I see under sculpt is "offsetSrf1" so I thought you used the "thicken/offset" option under the "Direct Edit" dropdown menu..I guess what I was wondering if how you were able to use sculpt to remova that material since I don't see any work-planes that you used?
Hi JD,
I think he was talking about:
But your Model did not Contain the Direct edit (I added that to show what it looks like in the broswer).
Regards,
James
NVM He posted what he meant...LOL
You wanted to cut away Loft 12 - so first thing I had to do is drag the red End of Part marker back in history, above the Loft 12 feature (see image).
The CADWhisperer YouTube Channel
Then I selected Thicken/Offset tool and set the output to Surface
and offset distance to zero to create a cutting tool for cutting the Loft feature.
I then dragged the red EOP marker back down below the loft and used the surface to Sculpt-cut the Loft.
The CADWhisperer YouTube Channel
I followed the insttructions that you gave but when I try to suclpt-cut it tells gives me an error (attached). Am selecting the material that needs to be cut properly?
Hi Luz_Wyatt,
Well I can tell by the picture you only have one surface.
A sculpt requires a fully closed shape to sculpt with...
Try making a few more surfaces with Patch or other methods.
It should work after that, I have a not-so perfect one minute edit here as an example. (Edited apparently my spelling was not so-perfect either 🙂 )
Its not perfect since I did not spend time to fix the edge joining the spout. ( You would need to spend time creating the right surface for that edge)
Regards,
James
First, ignore the example James posted - it is poorly done.
Edit the Thicken Offset feature and select the fillet (and maybe the planar disk as well).
You have to select enough surfaces such that the result completely cuts the feature you want to cut.
Rather than making a bunch of extra surfaces - the best solution is almost always to go back in history and offset the face when it is in its simplest form - before a bunch of trims (see the first Offset surface in my Vacuum Tutorial). I didn't use that surface until much futher down the feature tree, but I wanted to get it before it was all cut up by other features.
The CADWhisperer YouTube Channel
Hi! I used a hybrid modeling approach (solid and surface) to avoid creating the additional material in the first place. Please take a look and let me know if it makes sense.
Thanks!