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Curve driven Pattern in Assembly

15 REPLIES 15
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Message 1 of 16
Eugene777
6331 Views, 15 Replies

Curve driven Pattern in Assembly

Hi there ,

is it possible to create pattern in assembly???? . For example : i have a small parts which i want locate along a big part with dimension 500mm from each to other . (see image with conveyor belt)

15 REPLIES 15
Message 2 of 16
JDMather
in reply to: Eugene777

Yes, but -

 

An assembly file (*.iam) is only a list of hyperlinks to the part files (*.ipt) and a record of assembly constraints (and a bit more).

You must include the part files.


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Message 3 of 16

Hi Eugene777,

 

I think you'll want to create a workpoint in the part, then create the curve driven pattern in the part using the workpoint, and then in the assembly click pattern and use the Associative tab and the Feature Pattern Select button , and select the part level pattern to use as a guide.

 

http://help.autodesk.com/view/INVNTOR/2014/ENU/?guid=GUID-AFAEC6D0-BBAB-474F-B467-4F3E676BC4AF

 

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

Message 4 of 16

Sorry, guys ..
Could you explain me what exactly i must to do? Step by step..

In assembly i cant select driven curve ... i can select only components ..

Message 5 of 16
JDMather
in reply to: Eugene777

http://home.pct.edu/~jmather/SkillsUSA%20University.pdf

Pg 16-18

 

Attach your assembly here. Only need the belt and the angle bracket looking part.


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Message 6 of 16
Eugene777
in reply to: JDMather

Here is

Message 7 of 16
JDMather
in reply to: Eugene777

First thing I notice is - no dimensions on your belt?  There is one perfect R172, but no dimension.  What happened to the dimension?

 


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Message 8 of 16
Eugene777
in reply to: JDMather

Yes, dimensions is 172mm.
Message 9 of 16
JDMather
in reply to: Eugene777

First you must create a (workpoint) pattern in the belt part for the assembly component pattern to populate.

It says "Rectangular Pattern", but it is really a Curve Driven Pattern as described in the link above.

 

Component Pattern.png


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Message 10 of 16
Eugene777
in reply to: JDMather

Sorry for that,
But how to create a workpoint pattern ?
Message 11 of 16
JDMather
in reply to: Eugene777

http://home.pct.edu/~jmather/SkillsUSA%20University.pdf

Pg 16-18

 

See if you can figure it out from the document above.

I am not at my r2013 machine right now, but if you can't figure it out - I will show 2013 example later when I get a chance.


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Message 12 of 16
Eugene777
in reply to: JDMather

sorry , i cant figure out solution .
PLease show me how its work. I am on my way to improve CAD skills, sorry.
Thanks for understanding

Message 13 of 16

Hi Eugene777,

 

I don't have Inventor 2013 installed any longer, so I had to go back to Inventor 2010 for this, but it shouldn't matter.

 

1) Create a workpoint in the belt file.

2) Use the Rectangular Pattern tool in the belt file to pattern along the curve. Be sure to use the Direction1 Orientation and Adjust options as shown.

3) The result is the patterned workpoint

4) Next, in the assembly constrain the first component to the belt using assembly constraints as usual.

5) Then, in the assembly switch the browser to Modeling View (See JDMather's previous screen shot) and then use the Pattern tool, and select the component to pattern, and then select the workpoint pattern.

 

Autodesk Inventor Pattern.png

 

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

Message 14 of 16

Ohhhh, man!!!
this is exactly what i need.
Thank you very much.....
Message 15 of 16

Thanks for uploading that step by step pic. really helped with a big machine component outfit.
Message 16 of 16
stormarx
in reply to: JDMather

Thank you a lot! I understand it! The problem of me and the another guys was that we are not in Modeling view! When you are in the assemble mode you muse chose Modeling view  over the tree Robot LOL

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