Inventor General Discussion

Inventor General Discussion

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Eugene777
Posts: 20
Registered: ‎02-24-2014
Message 1 of 16 (445 Views)
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Curve driven Pattern in Assembly

445 Views, 15 Replies
03-06-2014 10:07 AM

Hi there ,

is it possible to create pattern in assembly???? . For example : i have a small parts which i want locate along a big part with dimension 500mm from each to other . (see image with conveyor belt)

First you must create a (workpoint) pattern in the belt part for the assembly component pattern to populate.

It says "Rectangular Pattern", but it is really a Curve Driven Pattern as described in the link above.

 

Component Pattern.png

Hi Eugene777,

 

I don't have Inventor 2013 installed any longer, so I had to go back to Inventor 2010 for this, but it shouldn't matter.

 

1) Create a workpoint in the belt file.

2) Use the Rectangular Pattern tool in the belt file to pattern along the curve. Be sure to use the Direction1 Orientation and Adjust options as shown.

3) The result is the patterned workpoint

4) Next, in the assembly constrain the first component to the belt using assembly constraints as usual.

5) Then, in the assembly switch the browser to Modeling View (See JDMather's previous screen shot) and then use the Pattern tool, and select the component to pattern, and then select the workpoint pattern.

 

Autodesk Inventor Pattern.png

 

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

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JDMather
Posts: 27,516
Registered: ‎04-20-2006
Message 2 of 16 (435 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:10 AM in reply to: Eugene777

Yes, but -

 

An assembly file (*.iam) is only a list of hyperlinks to the part files (*.ipt) and a record of assembly constraints (and a bit more).

You must include the part files.

Please mark this response as "Accept as Solution" if it answers your question.
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Curtis_Waguespack
Posts: 2,955
Registered: ‎03-08-2006
Message 3 of 16 (434 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:11 AM in reply to: Eugene777

Hi Eugene777,

 

I think you'll want to create a workpoint in the part, then create the curve driven pattern in the part using the workpoint, and then in the assembly click pattern and use the Associative tab and the Feature Pattern Select button , and select the part level pattern to use as a guide.

 

http://help.autodesk.com/view/INVNTOR/2014/ENU/?guid=GUID-AFAEC6D0-BBAB-474F-B467-4F3E676BC4AF

 

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com



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Contributor
Eugene777
Posts: 20
Registered: ‎02-24-2014
Message 4 of 16 (429 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:16 AM in reply to: Curtis_Waguespack

Sorry, guys ..
Could you explain me what exactly i must to do? Step by step..

In assembly i cant select driven curve ... i can select only components ..

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JDMather
Posts: 27,516
Registered: ‎04-20-2006
Message 5 of 16 (420 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:22 AM in reply to: Eugene777

http://home.pct.edu/~jmather/SkillsUSA%20University.pdf

Pg 16-18

 

Attach your assembly here. Only need the belt and the angle bracket looking part.

Please mark this response as "Accept as Solution" if it answers your question.
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Contributor
Eugene777
Posts: 20
Registered: ‎02-24-2014
Message 6 of 16 (415 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:24 AM in reply to: JDMather

Here is

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JDMather
Posts: 27,516
Registered: ‎04-20-2006
Message 7 of 16 (405 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:33 AM in reply to: Eugene777

First thing I notice is - no dimensions on your belt?  There is one perfect R172, but no dimension.  What happened to the dimension?

 

Please mark this response as "Accept as Solution" if it answers your question.
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Certified SolidWorks Professional
Inventor Professional 2015-SP1 64-bit
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Contributor
Eugene777
Posts: 20
Registered: ‎02-24-2014
Message 8 of 16 (403 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:38 AM in reply to: JDMather
Yes, dimensions is 172mm.
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JDMather
Posts: 27,516
Registered: ‎04-20-2006
Message 9 of 16 (397 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:47 AM in reply to: Eugene777

First you must create a (workpoint) pattern in the belt part for the assembly component pattern to populate.

It says "Rectangular Pattern", but it is really a Curve Driven Pattern as described in the link above.

 

Component Pattern.png

Please mark this response as "Accept as Solution" if it answers your question.
-----------------------------------------------------------------------------------------
Autodesk Inventor 2014 Certified Professional
Autodesk AutoCAD 2013 Certified Professional
Certified SolidWorks Professional
Inventor Professional 2015-SP1 64-bit
http://www.autodesk.com/edcommunity
http://home.pct.edu/~jmather/content/DSG322/inventor_surface_tutorials.htm
Contributor
Eugene777
Posts: 20
Registered: ‎02-24-2014
Message 10 of 16 (393 Views)

Re: Curve driven Pattern in Assembly

03-06-2014 10:57 AM in reply to: JDMather
Sorry for that,
But how to create a workpoint pattern ?
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