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You could meausure the length of your swept path. Just use the measure loop command and select the path of your swept. This will only give you the length and not allow you to use it in a BOM/Parameter.
Also, there is a way to put mass into a parameter, but you have to use a VB macro. Try asking on the customization discussion group for this.
Also, there is a way to put mass into a parameter, but you have to use a VB macro. Try asking on the customization discussion group for this.
Andrew In’t Veld
Designer
A. Bring Mass into Parameters for equations
It could be done via some customization, but it is not supported natively. It would be of little use though since including Mass in an equation that affected the model would result in an unending cyclical update. Equation involving mass drives model > model changes > mass changes >... (This behavior could be blocked, but it's not a trivial undertaking).
B. Have equations solved in the BOM
There is no direct equation support. The BOM (and associated parts lists) display property information. Exported parameters can be included since they are exported as custom properties. You can accomplish summing of values in parts list columns. So, if you need calculated values in the BOM or parts list, you must accomplish the calculations via parameters, and export the value to a custom property. The add-in mentioned above enables live updates to measured geometry in a part model, automatically updating the associated custom property (exported parameter) as the model changes.
It could be done via some customization, but it is not supported natively. It would be of little use though since including Mass in an equation that affected the model would result in an unending cyclical update. Equation involving mass drives model > model changes > mass changes >... (This behavior could be blocked, but it's not a trivial undertaking).
B. Have equations solved in the BOM
There is no direct equation support. The BOM (and associated parts lists) display property information. Exported parameters can be included since they are exported as custom properties. You can accomplish summing of values in parts list columns. So, if you need calculated values in the BOM or parts list, you must accomplish the calculations via parameters, and export the value to a custom property. The add-in mentioned above enables live updates to measured geometry in a part model, automatically updating the associated custom property (exported parameter) as the model changes.
Thanks for the great answer.
For me, I don't need to drive the model from this equation, simply be able to show the length in the parts list, so this sounds like the perfect solution.
I'll have an ask around in the customisation forum as unfortunately my VB skills are non-existant at this stage.
Of course if anyone here has some code lying around that will pull a iprop into parameters, that would be fantastic
Thanks again for the info,
Dion
For me, I don't need to drive the model from this equation, simply be able to show the length in the parts list, so this sounds like the perfect solution.
I'll have an ask around in the customisation forum as unfortunately my VB skills are non-existant at this stage.
Of course if anyone here has some code lying around that will pull a iprop into parameters, that would be fantastic
Thanks again for the info,
Dion
As River says, you can use iLogic to get the mass value into a parameter. To make sure it is up to date, you should force a part Update in the rule before retrieving the mass. Sample rule code:
InventorVb.DocumentUpdate()
Length = iProperties.Mass / 11.5
This rule will not guarantee that the Length parameter is up to date after changes in the part. You can set it to run on the Any Model Parameter Change event, but other things besides parameter changes can cause the mass to change.
You may have to run this rule manually to make sure the Length is up to date.
Mike
Mike Deck
Software Developer
Autodesk, Inc.
InventorVb.DocumentUpdate()
Length = iProperties.Mass / 11.5
This rule will not guarantee that the Length parameter is up to date after changes in the part. You can set it to run on the Any Model Parameter Change event, but other things besides parameter changes can cause the mass to change.
You may have to run this rule manually to make sure the Length is up to date.
Mike
Mike Deck
Software Developer
Autodesk, Inc.
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