Inventor General Discussion

Inventor General Discussion

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jcoates87
Posts: 2
Registered: ‎11-19-2012
Message 1 of 13 (794 Views)
Accepted Solution

BOM Reference parts & Hidden lines

794 Views, 12 Replies
11-19-2012 07:43 AM

Hello

 

I am doing a .idw drawing of an assembly that I have several parts that I do not want to appear in the BOM parts list. I have therefore set these parts as Reference parts however this has caused them to appear as "hidden type" lines in the drawing and are even visable through other parts.

Is there any way to make these parts appear in the drawing "as normal" and not be listed in the parts list?

 

Thanks for any help

"As normal", no... but, you can set some options for it on the "model state" tab when editing the view.

"Reference data - as parts" and "hidden line calculation - all bodies" will probably get something more desirable as you currently have.

*Expert Elite*
-niels-
Posts: 1,610
Registered: ‎06-20-2006
Message 2 of 13 (792 Views)

Re: BOM Reference parts & Hidden lines

11-19-2012 07:53 AM in reply to: jcoates87

"As normal", no... but, you can set some options for it on the "model state" tab when editing the view.

"Reference data - as parts" and "hidden line calculation - all bodies" will probably get something more desirable as you currently have.


Using IV2014 Pro SP2 - upd.1, Win7-64bit
New Member
jcoates87
Posts: 2
Registered: ‎11-19-2012
Message 3 of 13 (784 Views)

Re: BOM Reference parts & Hidden lines

11-19-2012 08:00 AM in reply to: jcoates87

Actually thats exactly what I was after. Thanks very much

Member
stephentaylor33
Posts: 4
Registered: ‎01-29-2013
Message 4 of 13 (693 Views)

Re: BOM Reference parts & Hidden lines

01-29-2013 11:40 AM in reply to: -niels-

Is there any way to do this for just one reference part but not all of them?

Steve Taylor
Drafter
Stork Food & Dairy Systems
*Expert Elite*
-niels-
Posts: 1,610
Registered: ‎06-20-2006
Message 5 of 13 (680 Views)

Re: BOM Reference parts & Hidden lines

01-29-2013 11:16 PM in reply to: stephentaylor33

The options mentioned only work on all reference parts in the idw environment.

 

What are you trying to accomplish exactly?

Maybe a different BOM state could help, or a different color style...


Using IV2014 Pro SP2 - upd.1, Win7-64bit
Member
stephentaylor33
Posts: 4
Registered: ‎01-29-2013
Message 6 of 13 (664 Views)

Re: BOM Reference parts & Hidden lines

01-30-2013 06:12 AM in reply to: -niels-

What I have is an assembly using a couple of pneumatic cylinders along with a large frame that needs to be a referenced part.  The cylinders are a purchased part but I need them to function using limits, appear on the BOM so that our vendors will know the necessary specs for the cylinder, and look like a regular part on the drawing.  My solution is to create an assembly of each cylinder out of two referenced parts (plunger and housing) so that it does not create a BOM, then put the cylinder assembly into the larger assembly as a flexible part. 

 

This makes the cylinder assembly appear as a reference part on the drawing (thin lines).  I can sometimes fix this by selecting the lines and changing line style.  But this doesn't work when there are hidden lines or for sections.  I would like a way to make the cylinder act like a normal part even though it contains only referenced parts.

 

Thanks for any help

Steve Taylor
Drafter
Stork Food & Dairy Systems
*Pro
sbixler
Posts: 1,952
Registered: ‎09-15-2003
Message 7 of 13 (661 Views)

Re: BOM Reference parts & Hidden lines

01-30-2013 06:20 AM in reply to: stephentaylor33

There's a much easier way for you: make the cylinder assembly Purchased.  This hides the component parts from the BOM.  No need to use reference parts for this case.

 

To make it Purchased (or Inseparable), open the Document Settings, go to the Bill of Materials tab, and change from Normal to Purchased.

Sam B
Inventor 2012 Certified Professional

Please click "Accept as Solution" if this response answers your question.
-------------------------------------------------------------------------------------
Inventor Professional 2013 SP1.1 Update 1
Windows XP Pro 32-bit, SP3
HP EliteBook 8730w; 4 GB RAM; Core™ 2 Duo T9400 2.53 GHz; Quadro FX2700M
SpaceExplorer/SpaceNavigator NB, driver 3.7.18
still waiting for a foreshortened radius dimensioning tool in Drawing Manager

*Expert Elite*
-niels-
Posts: 1,610
Registered: ‎06-20-2006
Message 8 of 13 (656 Views)

Re: BOM Reference parts & Hidden lines

01-30-2013 07:06 AM in reply to: sbixler

I agree with Sam, the purchased state will accomplish what you want.

 

In my company we use cylinders in a similar way for movement, but we leave them on the "normal" state.

We can do this because we use "all levels" for our BOM and do not expand the cylinders to show their components.

 

(i realize we could set them to purchased, but we just never did since it doesn't matter that much for us.)


Using IV2014 Pro SP2 - upd.1, Win7-64bit
*Pro
sbixler
Posts: 1,952
Registered: ‎09-15-2003
Message 9 of 13 (650 Views)

Re: BOM Reference parts & Hidden lines

01-30-2013 07:27 AM in reply to: -niels-

In our case, we actually place separate parts lists for fabricated parts and purchased parts, and this is how we filter the lists.  Very convenient!

Sam B
Inventor 2012 Certified Professional

Please click "Accept as Solution" if this response answers your question.
-------------------------------------------------------------------------------------
Inventor Professional 2013 SP1.1 Update 1
Windows XP Pro 32-bit, SP3
HP EliteBook 8730w; 4 GB RAM; Core™ 2 Duo T9400 2.53 GHz; Quadro FX2700M
SpaceExplorer/SpaceNavigator NB, driver 3.7.18
still waiting for a foreshortened radius dimensioning tool in Drawing Manager

Member
stephentaylor33
Posts: 4
Registered: ‎01-29-2013
Message 10 of 13 (635 Views)

Re: BOM Reference parts & Hidden lines

01-30-2013 12:24 PM in reply to: sbixler

Thankyou for the input but it didn't work. The problem that we may be having is that we use Autodesk Productstream as our data managment program.  Productstream still shows the parts in the BOM and when I look at the BOM in Inventor it also shows all the parts.  Should the parts still be visible in the BOM in Inventor? Or am I running into an Inventor function that just doesn't work with Productstream

Steve Taylor
Drafter
Stork Food & Dairy Systems
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