.ipt Custom iProperties to .idw Title Block

[MikeRid]

Inventor 2013

If I have created an .ipt template with custom iProperties is there a way to import that information into an .idw’s title block after the part is added to the drawing? My current set up imports information from the default iProperties fields but I would like to set it up to import from the part’s custom iProperties fields that I have created. 

[Curtis_Waguespack · Accepted solution]

Hi michaelridolfo,

There's a bit of a trick to it:

• Place the model with your custom iProperties in the drawing.
• Then edit the titleblock.
• Right-click on a text field and choose Edit Text or create a new test field.
• Use the Type pulldown and set it to Custom Properties - Model.
• Choose a custom property from the Property pull down.
• Then use the X-> button to add the property to the text field.

The trick is that you need to have the model on the sheet before Custom Properties - Model will show up in the list. Once you have this all set up in the title block you can delete the view of the model and save the drawing as your drawing template, so this will be set up in all new drawings. For existing drawings you can copy and past the titleblock into them, or use the Drawing Resource Transfer Wizard to batch replace the title block.

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

[japike]

When you edit your title block definition, you can add custom iproperties by using the "Type"  and "Property" drop downs when placing the text. First, select "Custom Properties - Model" from the Type drop down. Then select which custom property from the "Properties" drop down.

[mpatchus]

Simply edit your title block definition to bring in the properties that you wish to display.

For the type select CUSTOM PROPERTIES - Model, and then select the property you wish tto display.

[mpatchus]

you guys obviously type faster than I do!   LOL 

[MikeRid]

I was missing the step of putting the custom .ipt file in the .iwd first.

Thanks!

[qall]

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@mpatchus wrote:

Simply edit your title block definition to bring in the properties that you wish to display.

For the type select CUSTOM PROPERTIES - Model, and then select the property you wish tto display.

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@mpatchus

I do not see Custom properties-model in the drop-down menu of the text box, but Custom properties-drawing do exist.

Using IN2014

Thanks

[smilinger]

You can import additional custom properties here:

[SBix26]

Have you placed at least one view of the model in the drawing?  If you have and the custom properties still aren't available, please post your files here so somebody can figure out what's happening.

Sam B

Inventor Professional 2018.2.3
Windows 7 SP1

[qall]

@SBix26@smilinger

Thanks, yes properties come up when the part is placed in drawing etc, but not really preferred as it requires the drafter to change the standard title box text/properties each time creating a drawing, just a quality measure.

But it works that way if not many drawings are to be created.

[mpatchus]

Can you use one of the standard iProperty fields instead of a custom iProperty?

If not, if you define the text field in the title block as described previously, and add that title block to your drawing template, the custom fields will update in the title block anytime a part/model is used that contains that custom iProperty.

(PROVIDED that the custom iProperty name is an exact match.)

If a part is used in the drawing that does not contain that custom iProperty, the text will be blank.

[krancuretDX4VB]

@smilinger showed the location of the document setting, in idw files, that allows custom iproperties to be copied from the first model placed, by choosing <Select Document>. For some reason, only 1 of the 3 custom iproperties that I'm trying to put in my ipt templates are getting copied into the idw file after placement. How do I get all three to copy over?

[johnsonshiue]

Hi! I took a quick look at the files. I think I know where the problem is. In the part template, there are three custom iProperties: "Heat Treat", "Surface Treatment", and "Part Similar." In the drawing titleblock, only the first two are linked to Model. "Part Similar" is linked to the drawing instead. Please edit it and change it accordingly.

Another workflow you could consider is to link the model properties to the drawing. Open a drawing template or a draw file -> Tools -> Doc Settings -> Drawing -> Copy Model iProperties. After that, the model source iProperties will be populated to the drawing iProperties.

Many thanks!