Hi there Inventor Users World wide
I am in Joburg South Africa. Used Autocad for a long time, 2000 up to 2007, then Inventor on and off, since 2005, now full time for the last year. My first time using this forum, was on email guild and email WAUN (World Autocad Users Network)before.
I am struggling with an assembly drawing where I want to put in two Brake Valves in postion on the same mounting bracket, and then name 2 different views, each view showing the differnet valve visible. I have never used View representations, Positional Representations, or Level of Detail Representations before.
Can someone out there give me a quick guide on how I would do the above and which of the 3 I would use to achieve it.
I have tried experimenting and failed, I will read the help & probably work it out eventually.
I apologize as I don't have time for a more lengthy response, but this is an ideal situation for iAssemblies. Take a look into iAssemblies in your manuals and tutorials, help files, etc.
At work I have Inventor 2012
I am at home now. Here I only have Inventor 2009, Licensed, by the way, not pirate, but not likely ever to be upgraded at current cost.
I will investigate iassemblies. I have a feeling, if they are anything like Iparts, that it is not suitable.
I have a machine assembly drawing and would like to know how to save different views with different things visible.(similar to named views in Autocad) and then be able to restore that particular view with its given name.
I have these 2 valves in one machine assembly drawing. Both are in the same position (ie one merged with the other), but they are different lengths.
Both are not used at the same time. The one will be replacing the other, but I want them both in the same drawing, so I can see how to modify the mounting when replacing the one with the other.
Maybe this is not a good method of doing it, any other suggestions?
I think the View Representations are what you would want to use for this. You will be able to turn visibility for one valve off in one representation, and the other in a second one. On your drawing, you can pick which view rep you want each drawing view to reference. If you want to show the two conditions side by side, you just place two drawing views and set one to each representation.
With the iAssemblies, you would effectively be switching which one of the valves is in the assembly at the time, rather than having both in your assembly and switching which one is visible. Since they wouldn't exist in the assembly at the same time, you could not have drawing views of both. Doesn't sound like that's what you're looking for.
Levels of Detail could work as well, but I have bad luck with creating drawings that refer to more than one LOD. They are intended more as a memory management technique, so trying to use more than one at the same time can get a bit quirky.
Since they wouldn't exist in the assembly at the same time, you could not have drawing views of both.
I'm out of town and not near IV at the moment, and I could easily be missing something, but yes you can have drawing views of both. It's similar to what you described above for view representations. I have done it before but he needs to give more explanation on his bill of material needs because I think that could narrow down which tool is best. From what I can recall there is an actual AD tutorial on this somewhere. I apologize for not being able to spend more time but either way I think you should investigate all the options mentioned. There is a solution in there somewhere for you.
I suppose you're right, if he made the OVERALL assembly the iAssembly, rather than the valve (which is what I thought you meant at first). Then he would be able to place views referencing the two members.
If I'm understanding correctly what he is actually doing, there isn't really any BOM need. It sounds like he is swapping one part with another, in an existing piece of equipment, and needs to see what modifications will be required to make that work. If that is the case, I don't see what an iAssembly would get him that a view rep wouldn't.
Sorry I missed your replies last night. I am on my way to work just now.
Yes that is exactly my need. No BOM requirements, I am swapping one valve with another on an existing machine and need to make the modifications to enable it to fit.
I will investigate both your answers and be in touch, if not during the day, from home at weekend.
Inventor 2012 and Inventor 2009 are not that dissimilar that I can't esperiment at home, even though I can't use the same drawing (No 1-It is a work drawing on the work server. No 2-There is no backward compatability with lower versions in Inventor like there is in Autocad - Unfortunatley)
I still tend to think I will go with the LOD option, which I have tried before and couldn't get to work, was doing something wrong. I will however still look at your iassemblies method.
With the views and level of detail, what order do you do the turning off visibilty and naming views and saving the drawing
I have been turning off visibilty, creating a new view or level of detail, then saving, with a message coming up something about you will loose changes to something or the other. Then I have been swithing off visibility again, saving another level of detail and saving drawing again, with same message. All my level of details end up being the same as the very last one I created.
I am obviously missing something very basic here, in the order in which I am doing things. Any help appreciated.
I will hear you two guys when you wake up and are at work (this afternoon for me). Anybody else in a similar time zone to me GMT (Greenwich Mean Time)+2 - it would be nice to hear from you this morning
For either the LOD or View Rep, you need to create the representation first before doing the suppression or messing with visibility settings.
The message you are seeing is trying to tell you that all of your modifications were to the currently active representation, and will be lost if you don't save before switching to your new one.
So, the order should be:
1) Set things the way you want them in the current representation
2) Create new representation
3) Activate new representation
4) Set things the way you want in the new representation
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