Finish size of component

[indalkar.dattatray]

Dear  All,

I have a small question,

Is it possible to have  direct finish size of component in part list?

for more details  pls find attached two files.

Is there any tool for this or will it be possible by customization of software.

Thanks and Regards,

Datta Indalkar.

[Cadmanto]

Datta,

Do you mean like the volume of a component?

Did you look at the physical properties under iproperties?

[JDMather · Accepted solution]

I think the OP wants to automatically populate the 200 X 100 X 20 cell in the table.
I would start by naming these parameters in the part file.

[indalkar.dattatray]

Dear Sir,

As the part overall size is 200 x 100 x 20 . That  I want in bom. I am not intrested writting that size in i properties . it is manual process. 

software should itself choose that  overall size from model and put in to the part list.

Is it possible.will it be possible by custormazation of software or is there any soluction in current software?

Datta Indalkar

[sambaxter23 · Accepted solution]

This can be done with sheetmetal parts and custom properties.

See here:

http://usa.autodesk.com/adsk/servlet/ps/dl/item?siteID=123112&id=12405126&linkID=9242018

Alternately, you could use an ilogic rule to use the dimensions to drive a part title.

For example:

iProperties.Value("Project", "Part Number") = "my part is" + CStr(Round(Length,1)) + "L x " + CStr(Round(width,1)) + "W x " + CStr(Round(Thickness,1)) + "T"

* Replace "Length" with the dimension name assigned to the part length (get this from parameters). This can be a reference dimension.

* Replace "Width" with the dimension name assigned to the part width (get this from parameters).

* Replace "Thickness" with the dimension name assigned to the part thickness (get this from parameters).

* Replace "my part is" with whatever you want or just remove it.

* These can be done with a reference dimension if you don't have a driving dimension. These will also work with custom parameters.

Hope this helps!

[blair · Accepted solution]

another good link here: http://forums.autodesk.com/autodesk/attachments/autodesk/78/421283/1/Custom%20Parameter%20Formatting...

[indalkar.dattatray]

Dear Sir,

Thanks you very much for your help. it is working.

I have a  question ,

Is it possible to link one part file dimension to another part file?

1. Part first is a cylinder in parametric table i changed it,s name OD , ID  and thk. ( find attachment )

   Cylinder ID is ( ID=105)

2. Then i made 2 nd part whose step od ( od=102) is going to insert in to cylinder id.There is 3 mm clerance every time 

3. so i have to make equction in 2 nd part that ( Step OD= ( ID-3).

means next time when i will change ID of cylinder OD of 2 nd part will ger changed automatically minus by 3 mm than id of cylinder.

Pls help.

[rdyson · Accepted solution]

Yes, first export the parameter you want to control, then in the part that's to update with the controlled part: