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Hi Joris,
Please, try the following.
In the CC Editor, select the families where you want to replace the default material with another one, right-click, Material Guide.
In the following Material Guide wizard, at the second page, select the option “Add Materials as a new family members”
In the following page confirm the families selection and specify the custom library where you want to copy them, in case you have not copied yet it in your library.
In the next page, select the material to remove and the one to add.
In the following pages make the setting according to your preferences and start the process.
I hope it helps.
Kind regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
Please, tell me, for example, the name of one family, the material you want to remove and the material you want to add.
Thanks and regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
Example, make a part, an extruded cylinder, and bring it in the CC as a structural shape.
Next I want to use this cylinder in the frame generater and it can only be inserted as stainless steel with only one possible color assigned to it. The essence of cc parts is that they don´t change , so I want the material to be fixed to this part as well.
makes sence I think 
Well, not really.
I didn’t understand you were talking about custom parts published in the Content Center.
If this is the case and you cannot get the desired material and color after having published the part in the Content Center, evidently you are following the wrong workflow.
In order to avoid further misunderstandings, please share one of these parts before publishing it in the Content Center and tell me the material you want to assign it and get after having published the part and I will show you how to get the desired result.
Thanks and regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
The material assigned to the part you have sent me is Stainless Steel.
Which is the material you want to have once you have published the part in the Content Center?
Besides, for having the diameter 10 -12- 14..........20 mm you have to convert this part in an ipart before publishing it.
If you are not familiar with the ipart, I suggest you to follow the following tutorials.
http://usa.autodesk.com/adsk/servlet/item?siteID=123112&id=10921207&linkID=9242016
http://usa.autodesk.com/adsk/servlet/item?siteID=123112&id=10921570&linkID=9242016
In particular, the second one will show how to control the material and the color for the ipart.
Then, you can easily transferring these settings when you publish the part in the CC.
After that, you can have a look to the following tutorials that explain how to publish you ipart and using it in Frame Generator.
http://usa.autodesk.com/adsk/servlet/item?siteID=123112&id=12193815&linkID=9242016
http://usa.autodesk.com/adsk/servlet/item?siteID=123112&id=14351277&linkID=9242016
Thanks and regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
Ok.
In the meantime I’ll send you back the part you have sent me.
I’ve removed the color override that you have applied for some reason to the extrusion feature.
I’ve created the ipart with two diameter values and I’ve set the material to Copper (since I could not get the information from you about the material you want to use instead of Stainless Steel) with the corresponding color.
In the ipart table I’ve defined the length column as Custom one. This is in general a common practice for the steel shapes.
As you can see from the images below, I can select the length either in the Authoring and the Publishing.
You can, of course edit the table and apply the material you want with the corresponding color and publish the part.
Kind regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
Looks as things stay the same...
Ok, I use your Ipart with material copper, published it to the content center and when inserting the copper rod as a frame member, I still have the option to choose any material I want. This is not good because ( for this case) in my ware house
I have only copper rod. In this picture I insert the rod as galvanized steel, but I don´t have this material so it should not be in my custom CC obviously.
Also I can still choose any color I want when inserting the copper frame member.
Not good because I want a specific color always and only for copper.
Ok; Now I Use the CC editor to remove all the excesive material styles using the material guide.
I run trough the procces of adding copper and removing all the other materials but inventor is unable to remove any of them.
For removing unused color styles I don´t see any option.
Ok, you initial question is getting more clear.
So, if you insert my ipart from the CC, you just have one material and the corresponding color and I think this was answering to your initial question.
Instead, when you use it, or, any steel shapes with Frame Generator, selecting the member, the default material is the one set in the Family Table and the color is set to “As Material”.
It is true you can set a different material and color, but, you have to do it deliberately.
This behavior is “as design”, because Frame Generator offers the flexibility to apply different materials and colors from the Style library.
If this is an issue for you, you can create and use a different Style Library that contains just the materials and colors you want.
For doing this, start the Style Library Manager from Start > All Products > Autodesk > Autodesk Inventor 2012 > Tools > Style Library Manager.
On the left side, click on Create New Style Library.
Use the settings, for instance, as for the image below.
Select all the Materials you don’t want and delete them. Do the same with the colors.
After that, in your Inventor Project edit the Design Data path and select the new folder created above.
Kind regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
I’m not sure I’ve understood your last comment, but I’ll try to give an answer.
When you insert a Standard Part from the Content Center, the material is the one you have in the standard part Family Table.
If you insert the same Standard Part (Steel Shape) with the command Insert Frame, by default you get the material from the Family Table and the color is As Material, but, if you want, you can apply a different material or a different color Inventor takes from the Style Library.
If this is an issue for you, you can create and use a Style Library that contains just the material(s) and the color(s) you want, as I’ve explained in the previous post.
This behaviors described are identical if you use a standard part from one of the standard families you install with Inventor or if you are using a custom standard part. That is, a part you have created and published in the CC.
Kind regards,
Alessandro
Alessandro Gasso
Fusion 360 – Simulation/Generative Design Adoption Specialist
Autodesk, Inc.
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