Invalid axis/orgin

[Anonymous]

Quite often, I get the "Invalid axis/orgin" error from my sketch. It is
mainly due to the fact that I changed something (please forgive me, but I
have to do it from time to time) in a sketch. When the part is recomputed,
I get this error. One way that I have found to fix this problem is to RMB
on the sketch and chose "Redefine". Generally this will eliminate the error
message, but it creates others to appear.

What happens is the sketch is shifted and any geometry or constraints that
is linked to this geometry is jeoperdized and I usually have to fix the
constraints.

Most of the time it is quicker to just delete the sketch and start over.

Does anyone know of an easy way to clean up after I get this error
message???

Right now I am working in 5.3, not 6.0.

Thanks,
Kirk

--
Inventor 5.3 sp2 and 6.0
Win XP Pro
P4, 2 Ghz, 512M
Gloria II-64
nVidia v6.13.10.4041
1280x1024, 32 Bit

[Anonymous]

RMB on the sketch in the browser and select edit coordinate system. Click on the z of the
ucs and select a corner of the part then select a axis and select a corresponding axis off
the part. rmb done.

--
Kent
Member of the Autodesk Discussion Forum Moderator Program


"Kirk A." wrote in message
news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> Quite often, I get the "Invalid axis/orgin" error from my sketch. It is
> mainly due to the fact that I changed something (please forgive me, but I
> have to do it from time to time) in a sketch. When the part is recomputed,
> I get this error. One way that I have found to fix this problem is to RMB
> on the sketch and chose "Redefine". Generally this will eliminate the error
> message, but it creates others to appear.
>
> What happens is the sketch is shifted and any geometry or constraints that
> is linked to this geometry is jeoperdized and I usually have to fix the
> constraints.
>
> Most of the time it is quicker to just delete the sketch and start over.
>
> Does anyone know of an easy way to clean up after I get this error
> message???
>
> Right now I am working in 5.3, not 6.0.
>
> Thanks,
> Kirk
>
> --
> Inventor 5.3 sp2 and 6.0
> Win XP Pro
> P4, 2 Ghz, 512M
> Gloria II-64
> nVidia v6.13.10.4041
> 1280x1024, 32 Bit
>
>

[Anonymous]

What's going on is that you've created a sketch on the face of another
feature. IV automatically picks a random geometric piont on the feature to
be the sketch origin and axis. If you make a change to the base features
sketch that destroys the geometry to which the new sketch is attached it
gives this error. All you have to do is use "edit cordinate system" to
redefine the origin. Redefine also works but it changes all reference
geometry to normal and the origin (and consiquently the sketch features) may
end up in a different place than previous.

Your best bet to avoid this is to edit a new sketch's origin and referencing
it to point that you know will never change (such as the part origin).

Pat

"Kirk A." wrote in message
news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> Quite often, I get the "Invalid axis/orgin" error from my sketch. It is
> mainly due to the fact that I changed something (please forgive me, but I
> have to do it from time to time) in a sketch. When the part is
recomputed,
> I get this error. One way that I have found to fix this problem is to RMB
> on the sketch and chose "Redefine". Generally this will eliminate the
error
> message, but it creates others to appear.
>
> What happens is the sketch is shifted and any geometry or constraints that
> is linked to this geometry is jeoperdized and I usually have to fix the
> constraints.
>
> Most of the time it is quicker to just delete the sketch and start over.
>
> Does anyone know of an easy way to clean up after I get this error
> message???
>
> Right now I am working in 5.3, not 6.0.
>
> Thanks,
> Kirk
>
> --
> Inventor 5.3 sp2 and 6.0
> Win XP Pro
> P4, 2 Ghz, 512M
> Gloria II-64
> nVidia v6.13.10.4041
> 1280x1024, 32 Bit
>
>

[Anonymous]

Excellent answer, Pat!

If you didn't use the word "random" in your second sentence, your
answer would have been perfect 🙂 We use an algorithm that picks
the "best" geometry.

Glenn
Inventor Part Modeling

"Patrick Berry" wrote in message
news:67A30360D0EEFD149BD86D98D7D8E57A@in.WebX.maYIadrTaRb...
> What's going on is that you've created a sketch on the face of another
> feature. IV automatically picks a random geometric piont on the feature
to
> be the sketch origin and axis. If you make a change to the base features
> sketch that destroys the geometry to which the new sketch is attached it
> gives this error. All you have to do is use "edit cordinate system" to
> redefine the origin. Redefine also works but it changes all reference
> geometry to normal and the origin (and consiquently the sketch features)
may
> end up in a different place than previous.
>
> Your best bet to avoid this is to edit a new sketch's origin and
referencing
> it to point that you know will never change (such as the part origin).
>
> Pat
>
> "Kirk A." wrote in message
> news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> > Quite often, I get the "Invalid axis/orgin" error from my sketch. It is
> > mainly due to the fact that I changed something (please forgive me, but
I
> > have to do it from time to time) in a sketch. When the part is
> recomputed,
> > I get this error. One way that I have found to fix this problem is to
RMB
> > on the sketch and chose "Redefine". Generally this will eliminate the
> error
> > message, but it creates others to appear.
> >
> > What happens is the sketch is shifted and any geometry or constraints
that
> > is linked to this geometry is jeoperdized and I usually have to fix the
> > constraints.
> >
> > Most of the time it is quicker to just delete the sketch and start over.
> >
> > Does anyone know of an easy way to clean up after I get this error
> > message???
> >
> > Right now I am working in 5.3, not 6.0.
> >
> > Thanks,
> > Kirk
> >
> > --
> > Inventor 5.3 sp2 and 6.0
> > Win XP Pro
> > P4, 2 Ghz, 512M
> > Gloria II-64
> > nVidia v6.13.10.4041
> > 1280x1024, 32 Bit
> >
> >
>
>

[Anonymous]

Glen

If you are looking for the "Best" geometry, and his answer is near perfect,
why don't you just pick the origins, and this problem would go away?

--
Kent Keller
Member of the Autodesk Discussion Forum Moderator Program

http://www.MyMcad.com/KWiK/Mcad.htm

"Glenn" wrote in message
news:68CD5452BA47690AE5A9E6A39EBB9FE0@in.WebX.maYIadrTaRb...
> Excellent answer, Pat!
>
> If you didn't use the word "random" in your second sentence, your
> answer would have been perfect 🙂 We use an algorithm that picks
> the "best" geometry.
>
> Glenn
> Inventor Part Modeling

[Anonymous]

Touché!

As a user, I'd have to lean toward the description random, not best.

Richard

[Anonymous]

Kent,
I have a case of this staring at me right now. When I edit coordinate sys,
I only get an X-Y axis shown. Where is the "z" ?

Is this because I am sketching in the X-Y plane, and you may be using the
Y-Z or X-Z?

"Kent Keller" wrote in message
news:9910F4CBCA4B51BD389FA23FE64B67A3@in.WebX.maYIadrTaRb...
> RMB on the sketch in the browser and select edit coordinate system. Click
on the z of the
> ucs and select a corner of the part then select a axis and select a
corresponding axis off
> the part. rmb done.
>
> --
> Kent
> Member of the Autodesk Discussion Forum Moderator Program
>
>
> "Kirk A." wrote in message
> news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> > Quite often, I get the "Invalid axis/orgin" error from my sketch. It is
> > mainly due to the fact that I changed something (please forgive me, but
I
> > have to do it from time to time) in a sketch. When the part is
recomputed,
> > I get this error. One way that I have found to fix this problem is to
RMB
> > on the sketch and chose "Redefine". Generally this will eliminate the
error
> > message, but it creates others to appear.
> >
> > What happens is the sketch is shifted and any geometry or constraints
that
> > is linked to this geometry is jeoperdized and I usually have to fix the
> > constraints.
> >
> > Most of the time it is quicker to just delete the sketch and start over.
> >
> > Does anyone know of an easy way to clean up after I get this error
> > message???
> >
> > Right now I am working in 5.3, not 6.0.
> >
> > Thanks,
> > Kirk
> >
> > --
> > Inventor 5.3 sp2 and 6.0
> > Win XP Pro
> > P4, 2 Ghz, 512M
> > Gloria II-64
> > nVidia v6.13.10.4041
> > 1280x1024, 32 Bit
> >
> >
>
>

[Anonymous]

What Kent means is click on the origin of the triad indicator (which would
be like click on the Z-axis as its' pointing towards you) You are first
placing the origin then you can align the x,y axes to a feature edge...

--
Sean Dotson, PE
http://www.sdotson.com
Check the Inventor FAQ for most common questions
http://www.sdotson.com/faq.html
-----------------------------------------
"Kirk A." wrote in message
news:A1559322230142B97D6DA8E11280F0CF@in.WebX.maYIadrTaRb...
> Kent,
> I have a case of this staring at me right now. When I edit coordinate
sys,
> I only get an X-Y axis shown. Where is the "z" ?
>
> Is this because I am sketching in the X-Y plane, and you may be using the
> Y-Z or X-Z?
>
> "Kent Keller" wrote in message
> news:9910F4CBCA4B51BD389FA23FE64B67A3@in.WebX.maYIadrTaRb...
> > RMB on the sketch in the browser and select edit coordinate system.
Click
> on the z of the
> > ucs and select a corner of the part then select a axis and select a
> corresponding axis off
> > the part. rmb done.
> >
> > --
> > Kent
> > Member of the Autodesk Discussion Forum Moderator Program
> >
> >
> > "Kirk A." wrote in message
> > news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> > > Quite often, I get the "Invalid axis/orgin" error from my sketch. It
is
> > > mainly due to the fact that I changed something (please forgive me,
but
> I
> > > have to do it from time to time) in a sketch. When the part is
> recomputed,
> > > I get this error. One way that I have found to fix this problem is to
> RMB
> > > on the sketch and chose "Redefine". Generally this will eliminate the
> error
> > > message, but it creates others to appear.
> > >
> > > What happens is the sketch is shifted and any geometry or constraints
> that
> > > is linked to this geometry is jeoperdized and I usually have to fix
the
> > > constraints.
> > >
> > > Most of the time it is quicker to just delete the sketch and start
over.
> > >
> > > Does anyone know of an easy way to clean up after I get this error
> > > message???
> > >
> > > Right now I am working in 5.3, not 6.0.
> > >
> > > Thanks,
> > > Kirk
> > >
> > > --
> > > Inventor 5.3 sp2 and 6.0
> > > Win XP Pro
> > > P4, 2 Ghz, 512M
> > > Gloria II-64
> > > nVidia v6.13.10.4041
> > > 1280x1024, 32 Bit
> > >
> > >
> >
> >
>
>

[Anonymous]

I had a similar problem with a part file that referenced a skeleton model.
Everything the skeleton would regenerate, the sketches in the dependent
parts would lose their orientation. Maybe what I should do (and what you
could do) is create a workplane based on the defining geometry and then
place a sketch on that.

--
K


"Kirk A." wrote in message
news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> Quite often, I get the "Invalid axis/orgin" error from my sketch. It is
> mainly due to the fact that I changed something (please forgive me, but I
> have to do it from time to time) in a sketch. When the part is
recomputed,
> I get this error. One way that I have found to fix this problem is to RMB
> on the sketch and chose "Redefine". Generally this will eliminate the
error
> message, but it creates others to appear.
>
> What happens is the sketch is shifted and any geometry or constraints that
> is linked to this geometry is jeoperdized and I usually have to fix the
> constraints.
>
> Most of the time it is quicker to just delete the sketch and start over.
>
> Does anyone know of an easy way to clean up after I get this error
> message???
>
> Right now I am working in 5.3, not 6.0.
>
> Thanks,
> Kirk
>
> --
> Inventor 5.3 sp2 and 6.0
> Win XP Pro
> P4, 2 Ghz, 512M
> Gloria II-64
> nVidia v6.13.10.4041
> 1280x1024, 32 Bit
>
>

[Anonymous]

Kent,

When you create a sketch on a planar face, the selected face may not be
aligned with the origins. In that case, do you want the sketch origin and
axis to be aligned with a vertex and an edge of the selected face (current
behavior)? Or do want them to be aligned with the origins projected onto
the selected face? I'm sure that most users want the current behavior. If
we use the origins, the sketch origin could be way outside of the selected
face and the sketch axis could be undesirably tilted.

Glenn

"Kent Keller" wrote in message
news:AEB1232D65F4B9674A412E0004DABED3@in.WebX.maYIadrTaRb...
> Glen
>
> If you are looking for the "Best" geometry, and his answer is near
perfect,
> why don't you just pick the origins, and this problem would go away?
>
> --
> Kent Keller
> Member of the Autodesk Discussion Forum Moderator Program
>
> http://www.MyMcad.com/KWiK/Mcad.htm
>
> "Glenn" wrote in message
> news:68CD5452BA47690AE5A9E6A39EBB9FE0@in.WebX.maYIadrTaRb...
> > Excellent answer, Pat!
> >
> > If you didn't use the word "random" in your second sentence, your
> > answer would have been perfect 🙂 We use an algorithm that picks
> > the "best" geometry.
> >
> > Glenn
> > Inventor Part Modeling
>
>

[Anonymous]

Sorry. I thought the same right after I posted my message. - Glenn

"Richard Hinterhoeller" wrote in message
news:3DF74220.7000501@hfx.eastlink.ca...
> Touché!
>
> As a user, I'd have to lean toward the description random, not best.
>
> Richard
>

[Anonymous]

Glenn

Hope you understand that it was a honest question, and not trying to say it is done
wrong currently.

For me anything that makes the message show up less often is the best. I don't think
using the part origins for the sketch origins would be a issue, but I can see where the
axis would be for many (probably not for me generally because 95% of my stuff is square to
the origins.)

Thinking back at the times I have seen the invalid axis/origin message, it seems like it
is generally the origin it looses. Seldom is the edge that the axis is based on removed or
lost.

Not sure if you are aware of the problems I have had in migrating to 6, but one of them
is/was that I would consistently loose the axis/origin on a part when I did a update all
of the top assembly. This is one of the few part sketches I have that has no square
corners and so the UCS attached to the edge of a fillet. I would think in that case
attaching to the origin might have been more stable?

At any rate, thanks for the response, and keep up the good work.

--
Kent
Member of the Autodesk Discussion Forum Moderator Program


"Glenn" wrote in message
news:27F65B10940CDAB567BF6227DF4B4556@in.WebX.maYIadrTaRb...
> Kent,
>
> When you create a sketch on a planar face, the selected face may not be
> aligned with the origins. In that case, do you want the sketch origin and
> axis to be aligned with a vertex and an edge of the selected face (current
> behavior)? Or do want them to be aligned with the origins projected onto
> the selected face? I'm sure that most users want the current behavior. If
> we use the origins, the sketch origin could be way outside of the selected
> face and the sketch axis could be undesirably tilted.
>
> Glenn
>
> "Kent Keller" wrote in message
> news:AEB1232D65F4B9674A412E0004DABED3@in.WebX.maYIadrTaRb...
> > Glen
> >
> > If you are looking for the "Best" geometry, and his answer is near
> perfect,
> > why don't you just pick the origins, and this problem would go away?
> >

[Anonymous]

I figured there had to be some logic that it used to determine where to
default the origin. It's pretty rare though that it picks the geometry that
I would consider best. Most of the time I find myself picking an origin
that is located by some discrete point that is not influenced by changes in
the geometry, such as the origin.

My opinion is that it would be better if you were prompted to locate the
origin immediately when placing a new sketch or workplane (that's another
can of worms altogether). It's not always a good thing for the program to
think for you.

Thanks Glenn,

Pat

"Glenn" wrote in message
news:68CD5452BA47690AE5A9E6A39EBB9FE0@in.WebX.maYIadrTaRb...
> Excellent answer, Pat!
>
> If you didn't use the word "random" in your second sentence, your
> answer would have been perfect 🙂 We use an algorithm that picks
> the "best" geometry.
>
> Glenn
> Inventor Part Modeling
>
> "Patrick Berry" wrote in message
> news:67A30360D0EEFD149BD86D98D7D8E57A@in.WebX.maYIadrTaRb...
> > What's going on is that you've created a sketch on the face of another
> > feature. IV automatically picks a random geometric piont on the feature
> to
> > be the sketch origin and axis. If you make a change to the base
features
> > sketch that destroys the geometry to which the new sketch is attached it
> > gives this error. All you have to do is use "edit cordinate system" to
> > redefine the origin. Redefine also works but it changes all reference
> > geometry to normal and the origin (and consiquently the sketch features)
> may
> > end up in a different place than previous.
> >
> > Your best bet to avoid this is to edit a new sketch's origin and
> referencing
> > it to point that you know will never change (such as the part origin).
> >
> > Pat
> >
> > "Kirk A." wrote in message
> > news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> > > Quite often, I get the "Invalid axis/orgin" error from my sketch. It
is
> > > mainly due to the fact that I changed something (please forgive me,
but
> I
> > > have to do it from time to time) in a sketch. When the part is
> > recomputed,
> > > I get this error. One way that I have found to fix this problem is to
> RMB
> > > on the sketch and chose "Redefine". Generally this will eliminate the
> > error
> > > message, but it creates others to appear.
> > >
> > > What happens is the sketch is shifted and any geometry or constraints
> that
> > > is linked to this geometry is jeoperdized and I usually have to fix
the
> > > constraints.
> > >
> > > Most of the time it is quicker to just delete the sketch and start
over.
> > >
> > > Does anyone know of an easy way to clean up after I get this error
> > > message???
> > >
> > > Right now I am working in 5.3, not 6.0.
> > >
> > > Thanks,
> > > Kirk
> > >
> > > --
> > > Inventor 5.3 sp2 and 6.0
> > > Win XP Pro
> > > P4, 2 Ghz, 512M
> > > Gloria II-64
> > > nVidia v6.13.10.4041
> > > 1280x1024, 32 Bit
> > >
> > >
> >
> >
>
>

[Anonymous]

Kent,

> Hope you understand that it was a honest question, and not trying to say
it is done
> wrong currently.

Of course, I understood that. Sorry if my reply sounded argumentative
(although I didn't mean to!). IMO, written communication can get one wrong
more than oral communication. I've seen Sean D. experience it in this NG
;-) I even had the same experience with my wife when we exchanged our
e-mails. Since then, I don't use e-mails to communicate with my wife any
more 🙂 Kent, I truly respect you as a gentleman as I've seen you in both
Inventor and MDT NG's.

> For me anything that makes the message show up less often is the best. I
don't think
> using the part origins for the sketch origins would be a issue, but I can
see where the
> axis would be for many (probably not for me generally because 95% of my
stuff is square to
> the origins.)
>
> Thinking back at the times I have seen the invalid axis/origin message, it
seems like it
> is generally the origin it looses. Seldom is the edge that the axis is
based on removed or
> lost.

I agree with you. The sketch origin is more vulnerable than the sketch
axis. Right now, I'm looking at a bug that our QA reported. In that model,
a downstream sketch orgin is a vertex which we track as an intersection of
three adjacent faces (say F1, F2, and F3). When an upstream sketch
dimension is changed, the topology gets changed and the downstream sketch
loses its origin because we couldn't track the vertex, which now intersects
F1, F2, and F4. It's a legitimate failure, so I will return this bug to QA
as designed.

> Not sure if you are aware of the problems I have had in migrating to 6,
but one of them
> is/was that I would consistently loose the axis/origin on a part when I
did a update all
> of the top assembly. This is one of the few part sketches I have that has
no square
> corners and so the UCS attached to the edge of a fillet. I would think in
that case
> attaching to the origin might have been more stable?

The migration failure could be from some other cause. If there are no model
changes (either topology or geometry), then rebuild all should be
successful. Otherwise, it's a bug. I've seen your model once (it was an R6
migration bug), but the problem seemed to be something to do with project
file if I remember correctly. I'm not sure if we're talking about the same
model.

> At any rate, thanks for the response, and keep up the good work.

Thank you always.

Glenn
Inventor Part Modeling

[Anonymous]

Pat,

> My opinion is that it would be better if you were prompted to locate the
> origin immediately when placing a new sketch or workplane (that's another
> can of worms altogether). It's not always a good thing for the program to
> think for you.

We could get user inputs as MDT did. But again, the user can still make the
sketch origin invalid/missing by changing model unless s/he picks the part
origin.

IMO, there's no ideal solution for all situations 😞

Glenn

[Anonymous]

The reason I mentioned that it was a honest question, was because after
posting my original post and reading it a second time it sounded
argumentative to me. 8^) So if it sounded like that to me I figured it
probably sounded that way to others.

Anyhow we are getting off topic here. Thanks for the kind words, and for
being part of the Inventor community here.

--
Kent Keller
Member of the Autodesk Discussion Forum Moderator Program

http://www.MyMcad.com/KWiK/Mcad.htm

"Glenn" wrote in message
news:26F1631D4AB572E6AE43A39F628BBE45@in.WebX.maYIadrTaRb...

IMO, written communication can get one wrong
> more than oral communication. I've seen Sean D. experience it in this NG
> 😉 I even had the same experience with my wife when we exchanged our
> e-mails. Since then, I don't use e-mails to communicate with my wife any
> more 🙂

[Anonymous]

Hey! Leave me out of this

--
Sean Dotson, PE
http://www.sdotson.com
Check the Inventor FAQ for most common questions
http://www.sdotson.com/faq.html
-----------------------------------------
"Glenn" wrote in message
news:26F1631D4AB572E6AE43A39F628BBE45@in.WebX.maYIadrTaRb...

IMO, written communication can get one wrong
> more than oral communication. I've seen Sean D. experience it in this NG
> 😉 >

[Anonymous]

When you get this error and pick the part origin as the coordinate orgin,
does it change any of the geometry??
I have a part that has been giving me a fit. I will redefine the coordinate
system, then make a change on the skeleton. When everything is updated, I
get this same error again on the same part, same sketch. The last time that
I changed it, I picked the part orgin instead of a corner and right now it
seems to hold.

Does it really make any difference if I pick a vertex on the sketch or pick
the part origin to redefine the coordinate system to?

Thanks
Kirk


"Patrick Berry" wrote in message
news:BD93843622077E66F98633315DEF3C29@in.WebX.maYIadrTaRb...
> I figured there had to be some logic that it used to determine where to
> default the origin. It's pretty rare though that it picks the geometry
that
> I would consider best. Most of the time I find myself picking an origin
> that is located by some discrete point that is not influenced by changes
in
> the geometry, such as the origin.
>
> My opinion is that it would be better if you were prompted to locate the
> origin immediately when placing a new sketch or workplane (that's another
> can of worms altogether). It's not always a good thing for the program to
> think for you.
>
> Thanks Glenn,
>
> Pat
>
> "Glenn" wrote in message
> news:68CD5452BA47690AE5A9E6A39EBB9FE0@in.WebX.maYIadrTaRb...
> > Excellent answer, Pat!
> >
> > If you didn't use the word "random" in your second sentence, your
> > answer would have been perfect 🙂 We use an algorithm that picks
> > the "best" geometry.
> >
> > Glenn
> > Inventor Part Modeling
> >
> > "Patrick Berry" wrote in message
> > news:67A30360D0EEFD149BD86D98D7D8E57A@in.WebX.maYIadrTaRb...
> > > What's going on is that you've created a sketch on the face of another
> > > feature. IV automatically picks a random geometric piont on the
feature
> > to
> > > be the sketch origin and axis. If you make a change to the base
> features
> > > sketch that destroys the geometry to which the new sketch is attached
it
> > > gives this error. All you have to do is use "edit cordinate system"
to
> > > redefine the origin. Redefine also works but it changes all reference
> > > geometry to normal and the origin (and consiquently the sketch
features)
> > may
> > > end up in a different place than previous.
> > >
> > > Your best bet to avoid this is to edit a new sketch's origin and
> > referencing
> > > it to point that you know will never change (such as the part origin).
> > >
> > > Pat
> > >
> > > "Kirk A." wrote in message
> > > news:4841B69E619C19666F0B8C0DD2A59332@in.WebX.maYIadrTaRb...
> > > > Quite often, I get the "Invalid axis/orgin" error from my sketch.
It
> is
> > > > mainly due to the fact that I changed something (please forgive me,
> but
> > I
> > > > have to do it from time to time) in a sketch. When the part is
> > > recomputed,
> > > > I get this error. One way that I have found to fix this problem is
to
> > RMB
> > > > on the sketch and chose "Redefine". Generally this will eliminate
the
> > > error
> > > > message, but it creates others to appear.
> > > >
> > > > What happens is the sketch is shifted and any geometry or
constraints
> > that
> > > > is linked to this geometry is jeoperdized and I usually have to fix
> the
> > > > constraints.
> > > >
> > > > Most of the time it is quicker to just delete the sketch and start
> over.
> > > >
> > > > Does anyone know of an easy way to clean up after I get this error
> > > > message???
> > > >
> > > > Right now I am working in 5.3, not 6.0.
> > > >
> > > > Thanks,
> > > > Kirk
> > > >
> > > > --
> > > > Inventor 5.3 sp2 and 6.0
> > > > Win XP Pro
> > > > P4, 2 Ghz, 512M
> > > > Gloria II-64
> > > > nVidia v6.13.10.4041
> > > > 1280x1024, 32 Bit
> > > >
> > > >
> > >
> > >
> >
> >
>
>