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DRoam
Posts: 131
Registered: ‎01-03-2013
Message 1 of 6 (362 Views)
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Display only portion of assembly in an Inventor drawing view

362 Views, 5 Replies
01-10-2013 10:54 AM

Hi all,

 

Is there a way to have a view in a sheet that displays a few specific components of an master assembly? There is a motor/gear-box assembly within my master assembly that I don't want to make a separate assembly for BOM purposes, but I want a .ipn view with the motor/gear-box "assembly" exploded. I tried making everything else in the master assembly "not visible" for the particular .ipn view, which works fine, but if I add or replace anything in the master assembly, those additions appear in the motor/gear-box .ipn and screw up the view.

 

I could just make a whole new assembly for the motor/gear-box and use that for the exploded view, but I would rather the view update to reflect slight changes I make in the motor/gear-box "assembly" from within the master assembly.

 

So can I create a .ipn view and say, "I want these particular components of an assemly to appear in this view but nothing else"?

 

Thanks for your help,

Derek

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EScales
Posts: 74
Registered: ‎05-01-2007
Message 2 of 6 (356 Views)

Re: Display only portion of assembly in an Inventor drawing view

01-10-2013 11:10 AM in reply to: DRoam

Create a new LOD (Level Of Detail) in your master assembly, so you only have the motor/gear-box assembly displayed.

Create a new .ipn and when selecting the master assembly, you can choose which LOD you want to use.  Select the new LOD that only displays the motor/gear-box assembly.

When you create a view of the .ipn on the drawing, it will display only what is visible in the LOD that was used in the ipn.

Eric

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blair
Posts: 3,962
Registered: ‎11-13-2006
Message 3 of 6 (346 Views)

Re: Display only portion of assembly in an Inventor drawing view

01-10-2013 03:00 PM in reply to: EScales

I would probably use the "View Rep's" instead of LOD's. You have a few more options available as LOD is more of a memory management tool. You can easily copy the LOD's into a View-Rep.

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Curtis_Waguespack
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Message 4 of 6 (339 Views)

Re: Display only portion of assembly in an Inventor drawing view

01-10-2013 03:12 PM in reply to: DRoam

Hi DRoam,

 

As the others have said, If you use a representation in your IPN view, you'll be able to control parts as you add or remove them. I discuss this at this link using a color change as an example, but the same would apply to visibility changes:

http://forums.autodesk.com/t5/Autodesk-Inventor/Batch-Part-Selection/m-p/3371391#M428592

 

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

 

 



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sbixler
Posts: 1,873
Registered: ‎09-15-2003
Message 5 of 6 (311 Views)

Re: Display only portion of assembly in an Inventor drawing view

01-11-2013 05:57 AM in reply to: DRoam

I, too, would use a View Representation for this, but once you have it including the parts you want, you need to lock it.  If you don't lock it, new parts added to the assembly will be included.

 

However, you might also consider making the motor-gearbox into a Phantom Assembly.  That makes it a subassembly, so that you can easily keep control of what's in it, but making it Phantom means that as far as the BOM is concerned, all the parts are still at the master level.  To make the assembly Phantom, just change its BOM Attribute to "Phantom", either through the BOM Editor at the higher level, or through Document Settings.

Sam B
Inventor 2012 Certified Professional

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DRoam
Posts: 131
Registered: ‎01-03-2013
Message 6 of 6 (291 Views)

Re: Display only portion of assembly in an Inventor drawing view

01-11-2013 10:26 AM in reply to: DRoam

All of those sound like workable solutions, I'll have to play around and see which one works best. Thanks to all of you!

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