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I have made a drawing view of a main assembly (with sub-assemblies) and attached balloons to it... but I also have to make some additional drawing views of some sub-assemblies and then want the numbering to match the "main-assembly"... i.e. I want to specify the balloon numering source to be the main-assembly rather than the sub.
Is there no other way to solve this than to manually override the numbering... or to make representation views in the main assembly where everything except the sub-assembly is hidden!?
/T
The two solutions you've illustrated are what I would recommend (manual
override or a representation view that isolates the sub assembly - and I
would use an LOD rather than a design view rep).
There is currently not an explicit "re-direct BOM attributes" for item
numbering on sub assemblies, but it is something we're planning on providing
at some point.
--
Andrew Faix
Product Designer
Autodesk Inventor
wrote in message news:5847761@discussion.autodesk.com...
I have made a drawing view of a main assembly (with sub-assemblies) and
attached balloons to it... but I also have to make some additional drawing
views of some sub-assemblies and then want the numbering to match the
"main-assembly"... i.e. I want to specify the balloon numering source to be
the main-assembly rather than the sub.
Is there no other way to solve this than to manually override the
numbering... or to make representation views in the main assembly where
everything except the sub-assembly is hidden!?
/T
andrew,
Why are you recommending a LOD over design view reps in an idw?
I thought autodesks intentions were that a LOD was only a memory management tool when working on assemblies and a LOD should be copied to a design view to include on a drawing..
I don't really think my recommendation violates that concept. I'm
recommending an LOD because there's no need to take the memory hit for the
rest of the assembly you'll never need in the drawing view.
Also, I was just reminded that I'm now permitted to talk about Inventor 2009
functionality (but Beta testers are not - yet). So knowing that, I'm going
to amend my recommendation based on new functionality on parts lists.
You should actually create BOTH an LOD view and a Design view rep (and you
can spawn one from the other, so it's fairly simple).
The LOD will save you the memory impact, and the Design view rep will allow
you to filter your parts list on what's visible in a design view rep using
the new Parts List filter command available in Inventor 2009.
--
Andrew Faix
Product Designer
Autodesk Inventor
wrote in message news:5847872@discussion.autodesk.com...
andrew,
Why are you recommending a LOD over design view reps in an idw?
I thought autodesks intentions were that a LOD was only a memory management
tool when working on assemblies and a LOD should be copied to a design view
to include on a drawing..
Does this include only showing quantities for the visible parts within the
design view, or will it count all the duplicate parts including the
suppressed / invisible ones ?
Martin
"Andrew Faix (Autodesk)" wrote in message
news:5848024@discussion.autodesk.com...
No I didn't, but yes it is.
wrote in message news:5848010@discussion.autodesk.com...
>the new Parts List filter command available in Inventor 2009.
awesome! Thanks Andrew! (you did say that the filter was associative
right? 😉 )
This has never been an issue for us because i have been driving ny balloons with the Property Part Number ever since we starting using IV. I guess we started that way because that was how we did it in MDT. At first IV would only drive the balloon with the Item Number so i wrote a VBA routine to swap the two. Now however you can just make the Part Number be what drives you balloon with the Styles and all is good.
Now it there was only a way that I could make the Part Number field in my parts lists be formatted alfanumeric instead of text I would be able to sort as I need. To get around that I now leave leading zeros in my Part numbers to make it work.
If all instances are invisible via a design view, the parts list row is
hidden. Filter has no effect on qty.
--
Andrew Faix
Product Designer
Autodesk Inventor
"Martin G" wrote in message
news:5848170@discussion.autodesk.com...
Does this include only showing quantities for the visible parts within the
design view, or will it count all the duplicate parts including the
suppressed / invisible ones ?
Martin
"Andrew Faix (Autodesk)" wrote in message
news:5848024@discussion.autodesk.com...
No I didn't, but yes it is.
wrote in message news:5848010@discussion.autodesk.com...
>the new Parts List filter command available in Inventor 2009.
awesome! Thanks Andrew! (you did say that the filter was associative
right? 😉 )
![Autodesk Design & Make Report](https://forums.autodesk.com/t5/image/serverpage/image-id/1350519iCB55845EBFC43016/image-size/large?v=v2&px=999" "Autodesk Design & Make Report")