iLogic Drawing Views Scale

[devonjohnson]

Hi there,

I'm trying to put together some iLogic code to either check all the drawing views within a drawing sheet are all the same scale, or make the views all the same scale. These drawing sheets consist of a number of individual parts (they aren't projected views from a single part).

This is for welded assemblies.  We are required to generate a profile drawing sheet outlining each part that makes up the assembly. We send these out as dwg files for laser cutting so its important that the views are all the same scale.

Any help would be much appreciated, it's a tedious checking process at the moment!

Thanks

[Vladimir.Ananyev]

You may get scale for any drawing view in the drawing document.

Here is the sample iLogic rule that show scale of al drawing views in the drawing document.

'active drawing document
Dim oDrawDoc As DrawingDocument = ThisDrawing.Document

'get scale of all views in this drawing document
For Each oSheet As Sheet In oDrawDoc.Sheets
   For Each oView As DrawingView In oSheet.DrawingViews	
      MsgBox("Sheet: " & oSheet.Name & vbNewLine & _ 
	     "View: " & oView.Name & vbNewLine & _ 
	     "Scale: " & oView.Scale)		
   Next
Next

[devonjohnson]

Thanks for that, can this be amended to actually set the scale of all the views on a drawing sheet though? Or link all the views to the base view scale?

Thanks for your help

[Vladimir.Ananyev]

Yes, DrawingView.Scale property gets and sets the model to paper space scale of the view.

But setting this property is sensible only if the DrawingView.ScaleFromBase property returns False.

See the section "DrawingView" in the Inventor API help.

cheers

[devonjohnson]

Thanks........ I want to set all the views in the drawing sheet to be scaled the same as the base view scale.  I have code which displays a messagebox asking what scale the views need to be, but you have to enter a value for every view.  I just need all the views to be the same scale.

[mrattray · Accepted solution]

Dim oDrawDoc As DrawingDocument = ThisDrawing.Document
Dim oSheet As Sheet
Dim oSheets As Sheets
Dim oView As DrawingView
Dim oViews As DrawingViews
Dim oScale As Double

oScale = InputBox("Enter Desired Scale", "Scaler", "1")

oSheets = oDrawDoc.Sheets
For Each oSheet In oSheets
   oViews = oSheet.DrawingViews
   For Each oView In oViews	
       If oView.ScaleFromBase = False Then
           oView.Scale = oScale
       End If
   Next
Next

 Try this. You can change the behaviour of the input box by changing its location in the code. As it is, it will ask you once and set every view to that scale. If you put it under "For Each oSheet" then it will allow you to specify a different scale for each sheet, or if you put it under "For Each oView" then you'll have to specify a scale for every view on every sheet.

[devonjohnson]

Thanks so much Mike, thats exactly what I need!!

Appreciate you spending the time to help out 🙂

Devon

[devonjohnson]

Hi there again,

I actually just tweaked the code so it applied to only the active sheet - works a treat.  Thanks again!

Devon

[Anonymous]

Hi. When it run this code as a rual on a drawing I get an error 

Public Memeber 'DrawingViews' on Type "Sheets' not found. 

[Anonymous]

Never mind. I typed Sheet not Sheets. 

[Anonymous]

Hello Mike,

This is a great code! I'm trying to modify it to work when the sheet is active, so i can see the change. I have a total of 6 sheet. Can you tell me what part of the code is missing to do that?

Thanks

CADoor

[MechMachineMan]

It is missing

oSheet.Activate right after the line that has "For each oSheet in Sheets"

[Anonymous]

Thanks Justin,  

That worked perfect.

CADoor 

[davidahurlbut]

i saw this post, and cannot get it to change scales on the active sheet with the code from this post. is it supposed to be...

For Each oSheet In oSheets 
oSheet.Activate
   oViews = oSheet.DrawingViews

any help is greatly appreciated. thanks! 

[devonjohnson]

This the code that works for me, it works on any sheet I have active.


Dim oDrawDoc As DrawingDocument = ThisDrawing.Document
Dim oSheet As Sheet
Dim oView As DrawingView
Dim oViews As DrawingViews
Dim oScale As String

oScale = InputBox("Enter Desired Scale", "Scaler", "1:1")

   oSheet = oDrawDoc.ActiveSheet
   oViews = oSheet.DrawingViews
   For Each oView In oViews    
       If oView.ScaleFromBase = False Then
           oView.ScaleString = oScale
       End If
   Next

[devonjohnson]

This the code that works for me, it works on any sheet I have active.




Dim oDrawDoc As DrawingDocument = ThisDrawing.Document
Dim oSheet As Sheet
Dim oView As DrawingView
Dim oViews As DrawingViews
Dim oScale As String

oScale = InputBox("Enter Desired Scale", "Scaler", "1:1")

   oSheet = oDrawDoc.ActiveSheet
   oViews = oSheet.DrawingViews
   For Each oView In oViews    
       If oView.ScaleFromBase = False Then
           oView.ScaleString = oScale
       End If
   Next

[Curtis_Waguespack]

In case someone wants to go the other direction and keep scales that vary, there is a bit of iLogic at this link to check each view scale on the sheet and update the title block to read Varies if they are not all the same scale:

http://forums.autodesk.com/t5/inventor-general-discussion/overriding-auto-scale-in-title-block/m-p/6...

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com