How to Hide suppressed elements?

[Anonymous]

I have using Inventor api to open an assembly file.But while open the .iam file it will show all the suppressed elements.how can we hide this suppressed elements from showing?

here is my code

Dim asdoc As AssemblyDocument
asdoc = inventorApp.Documents.Open("F:\Arun\Master\Master_RF-VH-ZZ-0800-0500-0600.iam")

 Any one help??

[jdkriek]

When you suppress a component it creates a LOD (Level Of Detail), if you saved on Master then all those components would be visible again. Saving on the LOD will keep the supressed parts from showing up again.

[Mike.Wohletz · Accepted solution]

Suppressing elements will create a LOD and if you wish to open the document with the API you also will need to get the last LOD that was saved. You can do this as shown below and this is also an example that I had gotten from this forum someplace in the past. You can also look at all the LOD's and have an options box to pick what you want with a little more work as well. 

  Dim strFullFileName As String
        strFullFileName = "F:\Arun\Master\Master_RF-VH-ZZ-0800-0500-0600.iam"


        Dim oFileManager As FileManager
        oFileManager = ThisApplication.FileManager

        Dim strLastActiveLOD As String
        strLastActiveLOD = oFileManager.GetLastActiveLevelOfDetailRepresentation(strFullFileName)


        Dim strFullDocumentName As String
        strFullDocumentName = oFileManager.GetFullDocumentName(strFullFileName, strLastActiveLOD)

        Dim oDocOpenOptions As NameValueMap
        oDocOpenOptions = ThisApplication.TransientObjects.CreateNameValueMap

        Dim oDoc As Document
        oDoc = ThisApplication.Documents.OpenWithOptions(strFullDocumentName, oDocOpenOptions, True)

[Anonymous]

okey..

[Anonymous · Accepted solution]

Thanks....  Got the solution..This will help me a lot.. and change the LOD using code its working..

there some other code I  checked ,it is also working.here is the code

Dim oLOD As LevelOfDetailRepresentation
Dim oCompDef As AssemblyComponentDefinition
oCompDef = inventorApp.ActiveDocument.ComponentDefinition
oLOD = oCompDef.RepresentationsManager.LevelOfDetailRepresentations.Item(5)
oLOD.Activate()