attached is 2013 sample part...how would i make the section of the tank glass so that i can see inside the tank...picture attached
Dane
Solved! Go to Solution.
Solved by WHolzwarth. Go to Solution.
Solved by JDMather. Go to Solution.
One possible solution - examine technique and the delete student version file.
Well, that's another big mystery for me, with 2013 appearances.
Here's a workaround
Walter
Walter Holzwarth
Search here for Clear&.bmp for another possible solution (I haven't tried it in 2013).
I was looking at Walters solution and the bit i cannot seem to follow is the Surface 1 and Delete Face 2 ... how did you create the Surface 1 feature please?
Dane
Hmm. I must admit, that I didn't realize it before, but I thought, that you could select in former releases some faces in a non-transparent part and give them a transparent color. But it seems, that this never was possible in the past.
There are two possibilities:
1. Main color of part is non transparent. If some faces are changed to a normally transparent color, they remain opaque. No transpareny at all.
2. Main color of part is transparent. Even if some faces are changed to a non-transparent color, color change occurs, but the new color stays transparent, too.
Well, that's a wish for 2014:
Independent face switching from opaque to transparent or vice versa in single body IPTs.
Walter
Walter Holzwarth
I want to use the tank in an assembly....i need 1 view as normal and the other view as see through..would i need to use View Representation to accomplish this
Thanks
Dane
Yes
If you make the clear portion a new Solid Body and change the appearance for the Solid.
It still won't work if you change the appearance for the feature, it has to be changed for the Solid.
I thought maybe for this case you might be trying to use a Split face or something - I just checked and Split can be used to make separate bodies (in my case though, the widow I cut was the old Solid and the whole rest of the part became the new Solid, who knows what fun that might cause.)
My approach, similar to Walter's, however, I split the cylindrical faces (outside and inside) with a 3D sketch intersection and assigned the split faces a clear glass appearance.
On the view tab I set Shadows: All and Visual Style to Realistic, then allowed the ray tracing to complete its "good" pass.
The resulting image is attached.
After a little more investigation, the best way to do this and present the component as one part is using Multi-body parts. The completed part is attached.
That should do it for you.
-Bill
That did it, Bill. But are you really pleased with the result?
If a face of the main body is selected,and the same transparent color as used in the cutout is applied, no transparency occurs. That's confusing.
Walter
Walter Holzwarth
8. Click the Solid option (bottom left button) on the Split dialog box.
9. Click OK. You should have two solids.
13. In the part browser, expand the Solid Bodies node. Select the 2nd node. That should be the cutout.
14. In the QAT, change the appearance to Clear - Light (in the Inventor Appearance Library).
The face won't work, it has to be changed for the solid.
Correct Walter, you can't do that. I tried that and it didn't work.
So, it appears Inventor has a limitation in that it cannot correctly represent both transparent and opaque faces in the same body.
I can select the other body, the first one (main vessel shape) and apply the transparent appearance to that - see attached. But it must be the whole body.
Yes, Bill. That's state-of-the-art.
But it shouldn't last too long for the future.
Walter Holzwarth
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