Autodesk Inventor

[#1]

Can you have dropdowns in an ilogic FORM?

For example I want to setup 5 choices for a custom iproperty. Then when I run the form I can pick from those 5 choices only?

[#2]

The way I have done it in the past is with a Custom Parameter that is Exported to be a Custom iProperty.  I use the Multi-value list from the parameter to drive the value of the Custom iProperty

[#3]

Yep you sure can Here is my form I am working on now.

[#4]

Hi

How did make columns in your form?

[#5]

Mark, how do you export a multi-value text parameter?

[#6]

Actually I misspoke, I use an ilogic rule to copy the value of the MultiValue parameter to the value of the custom iproperty.  There is no export on the MultiValue parameters.

[#7]

Would you mind sharing this code?

[#8]

Hi everyone,

You can use MultiValue.SetList to add values and convert a parameter to a multi-value parameter.

Here's a quick example.

There is a sketch dimension / parameter called Length.

There is a rule with this line of code.

MultiValue.SetList("Length", 100, 150, 200, 250)

There is a form set up like this:

Attached is the example file (Inventor 2013)

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

[#9]

Hi mcgyvr,

You could also add a few lines to expose (export) the parameter value as a property. So using the previous example you set the Length using a form, and this code sets the list and ensures the parameter is exported as a custom iProperty.

'set list of values
MultiValue.SetList("Length", 100, 150, 200, 250)
Dim oLength As Parameter
oLength = Parameter.Param("Length")
oLength.ExposedAsProperty = True

But if you need the parameter value to be written to a custom iProperty that is not the same name as the parameter you could use something like this. In this example a custom iProperty called L1 is created or reused, depending if it exists. And the Length parameter value is written to it:

'set list of values
MultiValue.SetList("Length", 100, 150, 200, 250)

Dim propertyName1 As String = "L1"

'define custom property collection
oCustomPropertySet = ThisDoc.Document.PropertySets.Item("Inventor User Defined Properties")

Try
'set property value
oProp = oCustomPropertySet.Item(propertyName1)
Catch
' Assume error means not found so create it
oCustomPropertySet.Add("", propertyName1)
End Try

'set custom property value
iProperties.Value("Custom", "L1") = Length

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

[#10]

iproperty NOT parameter

I just want a form with a drop down to fill in the value of a custom iproperty.

Currently I'm doing it with an "Input Box" rule which is fine but not as pretty as I could make a form.

Seems totally silly to me this isn't build into ilogic forms already..

It should be as simple as this.. See attached