Autodesk Inventor

[#1]

I thought I knew but there is something else.

I have various styles created my behalf sheet metal panels.

Now I want from the base all four sides separate places because we want to be flexible in each side separately adjust the height.

The corners are in a certain way to each other and is dependent on the supplier there for the various styles.

When I made my panel and I change of style I had hoped that the corners would also change, but that does not happen.

If I place the four sides in the same command then the corners change after changing the style.

Now I can do a Corner Seam, but when I change the style, the corners not change.

Am I missing something or is this the manner of Inventor?

[#2]

I attach two parts where the different corners in.

I want to switch between the two styles(corners) in one part.

[#3]

i'm not sure what part of your corner you want to change when you change styles. Type of overlap? Gap? It appears that your gap is already controlled by your styles. Overlap is controlled by corner seam options and not by styles. I'm sorry, I think I'm not understanding what you are trying to accomplish.

[#4]

In the Inteco part the corner is equal.

In the Kemi part one site is longer then the other.

The lower corner, where the plates come together have to be the same, no cut outs(tear).

I want the two styles in one part and that i can change between the styles in the same part.

But as you say you can't control the overlap in a style then i have to change the Corner seam everytime i want to change the style.

[#5]

 "...i have to change the Corner seam everytime i want to change the style."

Yes, i believe your statement is true if it's the type of overlap you want to change when the sheetmetal style changes.

You could possibly do something with conditional feature suppression. Right click on corner2, select Properties and you will see some options for conditionally suppressing the corner. Maybe you could suppress corners based on the GapSize parameter which is set by your styles.

[#6]

Woud it be possible to do this with iLogic?

[#7]

Possibly. I'm at home right now and don't have Inventor in front of me. If no iLogic experts have posted by morning I will take a look when I get to work.

[#8]

Looks like something like this could work:

currentStyle = SheetMetal.GetActiveStyle()

If currentStyle = "Inteco_0.7" Then
    Feature.IsActive("Corner-Inteco") = True
    Feature.IsActive("Corner - Kemi") = False
Else If currentStyle = "Kemi" Then
    Feature.IsActive("Corner - Kemi") = True
    Feature.IsActive("Corner-Inteco") = False
End If

[#9]

Thanks Jeff

But wil this rule change the overlap which is not controlled by the style?

[#10]

No, the rule can only suppress and unsuppress features that are already created.  "Corner - Inteco" is a Corner Seam feature with the "No Overlap" opton and "Corner - Kemi" is a Corner Seam feature with the "Overlap" option. Both features are applied to the same corner, but one or the other is suppressed based on which sheetmetal style you choose.

Another possibility might be an iPart. Still a bit cumbersome but possible.